Using a , you can apply a force to an individual node or a set of nodes. You must create a node-based Named Selection before you can apply a . The that you apply in Mechanical is represented as an F Command in the Mechanical APDL application.
is available for the following analysis types:
Eigenvalue Buckling (for Nonlinear-based Eigenvalue Buckling Analysis only)
The following section outlines the common boundary condition characteristics that include application requirements of the boundary condition, support limitations, as well as loading definitions and values.
Dimensional Types
3D Simulation: Supported.
2D Simulation: Supported.
Geometry Types: Geometry types supported for the boundary condition include:
Solid: Supported.
Surface/Shell: Supported.
Wire Body/Line Body/Beam: Supported.
Topology: The boundary condition is scoped via node-based Named Selections only. See the Specifying Named Selections by Direct Node Selection Help section for more information.
Note: The Nodal Force boundary condition supports spatially varying loading on the scoped nodes for Static and Transient analyses only. For Harmonic Response and Eigenvalue Buckling analyses, only constant loading conditions are supported.
To apply a :
On the Environment toolbar, click > . Or, right-click the Environment tree object or the Geometry window and select >.
Click the Named Selection drop-down list and then select the node-based Named Section to prescribe the scope of the Nodal Force.
Enter a magnitude for the X, Y, and Z component to define the load.
Tip: Define a Nodal Orientation for the Named Selection to control the Nodal Coordinate System.
The Details View selections are described below.
| Category | Fields/Options/Description | |
|---|---|---|
| Scope |
Scoping Method: a read-only field that displays scoping method - Named Selection . Named Selection: a drop-down list of available node-based Named Selection. | |
| Definition |
Type: a read-only field that describes the node-based object - . Coordinate System: a read-only field that displays the coordinate system - Nodal Coordinate System. The Nodal Coordinate System can be modified by applying Nodal Orientation objects. X Component: defines force in the X direction Y Component: defines force in the Y direction Z Component: defines force in the Z direction
Divide Load by Nodes: options include:
Suppressed: includes or excludes the boundary condition in the analysis. |
When Divide Load by Nodes is set to Yes, the forces are evenly distributed across the nodes and do not result in a constant traction.
Two Nodal Force objects that have same scoping do not produce a cumulative loading effect. The Nodal Force that was specified last takes priority and is applied, and as a result, the other Nodal Force is ignored. For Explicit Dynamics analyses, a resultant effect is always calculated if multiple loads are applied to a node (either by geometric entity or as a nodal force).
A load applied to a geometric entity and a Nodal Force produce a resultant effect.