Applies a compression only constraint normal to one or more faces. It is modeled internally using Asymmetric rigid-flexible contact. A rigid target surface is constructed and/or mirrored from the scoped faces/edges of the Compression Only Support. Therefore, the following points should be kept in mind:
The underlying technology is using penalty-based formulations. As a result, normal contact stiffness can be an important parameter if nonlinear convergence issues arise. Control normal contact stiffness using the Normal Stiffness property of the Compression Only Support object.
Because source and target topologies are perfect mirrors of one another, be careful during nonlinear analyses to make that contact doesn't "fall off" the target face. Be sure that the contacting area on the rigid body is large enough to accommodate any potential sliding taking place during the analysis. To avoid this, consider using a fully fixed rigid body and a nonlinear contact to replace the compression only support.
Consider the following model with a bearing load and supports as shown.
Note the effect of the compression only support in the animation of total deformation.
The following demo is presented as an animated GIF. View online if you are reading the PDF version of the help. Interface names and other components shown in the demo may differ from those in the released product.
Since the region of the face in compression is not initially known, a nonlinear solution is required and may involve a substantial increase in solution time.
A Compression Only Support is available for the following analysis types:
The following section outlines the common boundary condition characteristics that include application requirements of the boundary condition, support limitations, as well as loading definitions and values.
Dimensional Types
3D Simulation: Supported.
2D Simulation: Supported.
Geometry Types: Geometry types supported for the Compression Only Support boundary condition include:
Solid: Supported.
Surface/Shell: Not Supported.
Wire Body/Line Body/Beam: Not Supported.
Topology: The following topology selection options are supported for Compression Only Support.
Body: Not Supported.
Face: Supported - 3D Only.
Edge: Supported - 2D Only.
Vertex: Not Supported.
Nodes: Not Supported.
To apply a Compression Only Support:
On the Environment context toolbar: click Supports>Compression Only Support. Or, right-click the Environment tree object or the Geometry window and select Insert>Compression Only Support.
Specify Scoping Method and or .
Specify Normal Stiffness property. If set to , enter a Normal Stiffness Factor value.
Specify Update Stiffness property.
The selections available in the Details view are described below.
| Category | Fields/Options/Description |
|---|---|
| Scope |
Scoping Method: Options include:
|
| Definition |
Type: Read-only field that describes the object - Compression Only Support. Normal Stiffness: Defines a contact Normal Stiffness factor. Options include:
Update Stiffness: Specify if the program should update (change) the contact stiffness during the solution. Options include:
Suppressed: Include ( - default) or exclude () the boundary condition. |