Pressure

A pressure load applies a constant pressure or a varying pressure in a single direction (x, y, or z) to one or more flat or curved faces. A positive value for pressure acts into the face, compressing the solid body.

Analysis Types

Pressure is available for the following analysis types:


Note:  Eigen response (an Eigenvalue Buckling Analysis or a Modal Analysis) and Harmonic Response (Full) analyses take into account any pressure load stiffness contribution applied in a linked Static Structural analysis.


Common Characteristics

This section describes the characteristics of the boundary condition, including the application requirements, support limitations, and loading definitions and values.

Types Supported

Geometry Types: Geometry types supported for the Pressure boundary condition include:

Topology: The following topology selection options are supported for Pressure.

Loading Types: The boundary condition’s loading is defined using one of the following options.

Loading Data Definition : Enter loading data using one of the following options.


Note:   Harmonic Response Analysis Only: Spatially varying Tabular and Function data is supported for the Normal To and Normal To: Real-Imaginary loading types. The Phase Angle property supports Spatially varying Tabular definition but does not support Function definition.


Boundary Condition Application

To apply a Pressure:

  1. On the Environment context toolbar: click Loads>Pressure. Or, right-click the Environment tree object or the Geometry window and select Insert>Pressure.

  2. Define the Scoping Method.

  3. Select the method used to define the Pressure: Normal To (default), Normal To: Real - Imaginary, Vector, Vector: Real - Imaginary, Components, or Components: Real - Imaginary.

  4. Define the Magnitude, Coordinate System, and/or Direction of the Pressure based on the above selections.

  5. For Harmonic analyses, specify a Phase Angle as needed.

Details View Properties

The selections available in the Details view are described below.

CategoryFields/Options/Description
Scope

Scoping Method, options include:

  • Geometry Selection: Default setting, indicating that the boundary condition is applied to a geometry or geometries, which are chosen using a graphical selection tools.

    • Geometry: Visible when the Scoping Method is set to Geometry Selection. Displays the type of geometry (Body, Face, etc.) and the number of geometric entities (for example: 1 Body, 2 Edges) to which the boundary has been applied using the selection tools.

  • Named Selection: Indicates that the geometry selection is defined by a Named Selection.

    • Named Selection: Visible when the Scoping Method is set to Named Selection. This field provides a drop-down list of available user–defined Named Selections.

Definition

Type: Read-only field that describes the object - Pressure.

Define By, options include:

  • Normal To: Requires a Magnitude entry.

  • Applied By (Static Structural and Transient Structural analyses only): This property is visible when you set the Define By property to Normal To. Options include:

    • Surface Effect (default)

    • Direct

  • Normal To: Real - Imaginary (Harmonic Analysis only): Real and imaginary magnitude. Requires the specification of the following inputs:

    • Magnitude - Real

    • Magnitude - Imag

  • Vector: A magnitude and direction (based on selected geometry). Requires the specification of the following inputs:

  • Vector: Real - Imaginary (Harmonic Analysis only): Real and imaginary magnitude and direction (based on selected geometry). Requires the specification of the following inputs:

    • Magnitude - Real

    • Magnitude - Imag

    • Direction

  • Components: Option to define the loading type as Components (in the world coordinate system or local coordinate system, if applied). Requires the specification of at least one of the following inputs:

    • Coordinate System: Drop-down list of available coordinate systems. Global Coordinate System is the default.

    • X Component: Defines magnitude in the X direction.

    • Y Component: Defines magnitude in the Y direction.

    • Z Component: Defines magnitude in the Z direction.

    • X Phase Angle (Harmonic Analysis only)

    • Y Phase Angle (Harmonic Analysis only)

    • Z Phase Angle (Harmonic Analysis only)


    Note:  Selection of a Coordinate System rotated out of the global Cartesian X-Y plane is not supported in a 2D analysis.


  • Components: Real - Imaginary (Harmonic Analysis only): Option to define the loading type as real and imaginary components (in the world coordinate system or local coordinate system, if applied). Requires the specification of at least one of the following inputs:

    • Coordinate System: Drop-down list of available coordinate systems. Global Coordinate System is the default.

    • X Component - Real: Defines magnitude (Real) in the X direction.

    • X Component - Imaginary: Defines magnitude (Imaginary) in the X direction.

    • Y Component - Real: Defines magnitude (Real) in the Y direction.

    • Y Component - Imaginary: Defines magnitude (Imaginary) in the Y direction.

    • Z Component - Real: Defines magnitude (Real) in the Z direction.

    • Z Component - Imaginary: Defines (Imaginary) magnitude in the Z direction.

Suppressed: Include (No - default) or exclude (Yes) the boundary condition.

Mechanical APDL References and Notes

The following Mechanical APDL commands, element types, and considerations are applicable for this boundary condition.


Release 18.2 - © ANSYS, Inc. All rights reserved.