A pressure load applies a constant pressure or a varying pressure in a single direction (x, y, or z) to one or more flat or curved faces. A positive value for pressure acts into the face, compressing the solid body.
Pressure is available for the following analysis types:
Note: Eigen response (an Eigenvalue Buckling Analysis or a Modal Analysis) and Harmonic Response (Full) analyses take into account any pressure load stiffness contribution applied in a linked Static Structural analysis.
This section describes the characteristics of the boundary condition, including the application requirements, support limitations, and loading definitions and values.
Types Supported
3D Simulation: Supported. For 3D simulations, a pressure load applies a pressure to one or more faces.
2D Simulation: Supported. For 2D simulations, a pressure load applies a pressure to one or more edges.
Geometry Types: Geometry types supported for the Pressure boundary condition include:
Solid: Supported.
Surface/Shell: Supported.
Wire Body/Line Body/Beam: Not Supported.
Topology: The following topology selection options are supported for Pressure.
Body: Not Supported.
Face: Supported - 3D. If you select multiple faces when defining the pressure, the same pressure value gets applied to all selected faces. If a constant pressurized face enlarges due to a change in CAD parameters, the total load applied to the face increases, but the pressure (force per unit area) value remains constant.
Edge: Supported - 2D. If you select multiple edges when defining the pressure, the same pressure value gets applied to all selected edges.
Vertex: Not Supported.
Nodes: Not Supported.
Loading Types: The boundary condition’s loading is defined using one of the following options.
: Supported.
During a Static Structural or a Transient Structural analysis, the Pressure boundary condition displays the property Applied By. This property has two options: (default) and . The option applies pressure using the surface effect elements created on the top of the scoped geometry and the option applies pressure directly onto the nodes of the scoped geometry.
If you scope two pressure objects to the same geometry using the option, the pressures do not produce a cumulative loading effect. The Pressure object that you specified last takes priority and is applied, and as a result, the application ignores the other Pressure object. If a Nodal Pressure and a Direct Pressure share the same scoping, the Nodal Pressure always takes priority regardless of insertion order: Mechanical will ignore the Direct Pressure.
A pressure applied using the option and a pressure applied with the option produce a resultant effect.
A pressure applied with the option to shell bodies act in the opposite direction of pressures applied using the option.
When you scope a Pressure to a solid body as well as a shell body, the application does not display the annotation arrow for the loading direction (via the Direction property).
During a structural analysis, you can also create a spatially varying load using the type option. A spatially varying load allows you to define the pressure in tabular form or as a function.
3D Faces or 2D Edges automatically update their direction at each substep and "follow" the changing normal for large deflection analysis.
Applying a pressure load normal to faces (3D) or edges (2D) could result in a pressure load stiffness contribution that plays a significant role in analyses that support pre-stress (Pre-stressed Full Harmonic, Pre-stressed Modal, and Eigenvalue Buckling) because they use the Static Structural Solution as a starting point.
: Supported. While loads are associative with geometry changes, load directions are not.
The vector load definition displays in the Annotation legend with the label Components. The Magnitude and Direction entries, in any combination or sequence, define these displayed values. These are the values sent to the solver.
: Supported.
. Supported for Harmonic Response Analysis only. Define direct loading without Phase Angle.
. Supported for Harmonic Response Analysis only. Define direct loading without Phase Angle.
. Supported for Harmonic Response Analysis only. Define direct loading without Phase Angle.
Loading Data Definition : Enter loading data using one of the following options.
Constant: Supported.
Tabular (Time Varying): Supported.
Tabular (Step Varying): Supported for Static Structural analysis only.
Tabular (Frequency Varying): Supported for Harmonic Response Analysis only.
By default, at least two frequency entries are required when defining a frequency dependent tabular load. The Pressure boundary condition in a Harmonic Response (Full, linked MSUP, or standalone) can be defined in such a way that it is fully frequency dependent. That is, the magnitude of the load as well as the Phase Angle of the load can be dependent upon the frequency definitions.
Tabular (Spatially Varying): Supported.
Function (Time Varying): Supported.
Function (Spatially Varying): Supported.
Note: Harmonic Response Analysis Only: Spatially varying Tabular and Function data is supported for the and loading types. The Phase Angle property supports Spatially varying Tabular definition but does not support Function definition.
To apply a Pressure:
On the Environment context toolbar: click Loads>Pressure. Or, right-click the Environment tree object or the Geometry window and select Insert>Pressure.
Define the Scoping Method.
Select the method used to define the Pressure: Normal To (default), , , , , or .
Define the Magnitude, Coordinate System, and/or Direction of the Pressure based on the above selections.
For Harmonic analyses, specify a Phase Angle as needed.
The selections available in the Details view are described below.
| Category | Fields/Options/Description |
|---|---|
| Scope |
Scoping Method, options include:
|
| Definition |
Type: Read-only field that describes the object - Pressure. Define By, options include:
Suppressed: Include ( - default) or exclude () the boundary condition. |
The following Mechanical APDL commands, element types, and considerations are applicable for this boundary condition.