Bolt Pretension

This boundary condition applies a pretension load to a cylindrical face, to a straight edge of a line body, to a single body, or to multiple bodies, or to a Beam Connection, typically to model a bolt under pretension.

Analysis Types

Bolt Pretension is applicable to pure structural or thermal-stress analyses:

Common Characteristics

This section describes the characteristics of the boundary condition, including the application requirements, support limitations, and loading definitions and values.

Dimensional Types

Be sure that a sufficiently fine mesh exists on a face or body that contains a Bolt Pretension boundary condition so that the mesh can be correctly partitioned along the axial direction (that is, at least two elements long).

Geometry Types: Geometry types supported for the Bolt Pretension boundary condition include:

Topology: The following topology selection options are supported for Bolt Pretension.

Loading Types: The boundary condition’s loading is defined using one of the following options.

Loading Data Definition : Bolt Pretension is defined by constant loading data only.

Boundary Condition Application

To apply a Bolt Pretension:

  1. On the Environment context toolbar: click Loads>Bolt Pretension. Or, right-click the Environment tree object or the Geometry window and select Insert>Bolt Pretension.

  2. Define the Scoping Method.

  3. Specify how the boundary condition is defined: by Load, Adjustment, or Open

Details View Properties

The selections available in the Details view are described below.

CategoryFields/Options/Description
Scope Scoping Method, options include:
  • Geometry Selection: Default setting, indicating that the boundary condition is applied to a geometry or geometries, which are chosen using a graphical selection tools.

    • Geometry: Visible when the Scoping Method is set to Geometry Selection. Displays the type of geometry (Face, Edge, etc.) and the number of geometric entities (for example: 1 Face, 2 Edges) to which the boundary has been applied using the selection tools.

  • Named Selection: Indicates that the geometry selection is defined by a Named Selection.

    • Named Selection: Visible when the Scoping Method is set to Named Selection. This field provides a drop-down list of available user–defined Named Selections.

  • Beam Connection: This option enables you to scope the pretension load to a Beam Connection.

    • Beam Connection: Visible when the Scoping Method is set to Beam Connection. This field provides a drop-down list of available user-defined beam connections.

Coordinate System (Body scoping only): Drop-down list of available coordinate systems. Global Coordinate System is the default. This property is not available for beam connection scoping.

Definition

Type: Read-only field that displays boundary condition type - Bolt Pretension.

Suppressed: Include (No - default) or exclude (Yes) the boundary condition.

Define By, options include:

  • Load

  • Adjustment

  • Lock

  • Open

  • Increment

Preload: Visible when the Define By is set to Load.

Preadjustment: Visible when the Define By is set to Adjustment.

Increment: Visible when the Define By is set to Increment.

Presented below is a model showing a Bolt Pretension load as a preload force and as a pre-adjustment length:

The following animation shows total deformation:

The following demo is presented as an animated GIF. View online if you are reading the PDF version of the help. Interface names and other components shown in the demo may differ from those in the released product.


Release 18.2 - © ANSYS, Inc. All rights reserved.