Applies thermal radiation to a surface of a model (an edge in a 2D model). You can define the exchange of radiation between a body and the ambient temperature, or between two surfaces.
For thermal related analyses that use the ANSYS solver, the actual calculation of the radiation exchange between two surfaces is performed using the Radiosity Solver method. The Radiosity Solver method accounts for the heat exchange between radiating bodies by solving for the outgoing radiative flux for each surface, when the surface temperatures for all surfaces are known. The surface fluxes provide boundary conditions to the finite element model for the conduction process analysis in Workbench. When new surface temperatures are computed, due to either a new time step or iteration cycle, new surface flux conditions are found by repeating the process. The surface temperatures used in the computation must be uniform over each surface facet to satisfy the conditions of the radiation model.
For models that are entirely symmetrical, you can account for symmetry using Symmetry Regions or Cyclic Regions. The Radiosity Solver method respects plane or cyclic symmetries. Using a model's symmetry can significantly reduce the size of the model. The Radiosity Solver method will take symmetry into account and the Radiation Probe solution results will be valid for the full model.
Settings for the Radiosity Solver method are available under the Analysis Settings object in the Radiosity Controls category.
See the sections of the Mechanical APDL help listed below for further information related to using the Radiation load in thermal related analyses that employ the ANSYS solver.
Radiation is available for the following analysis types:
This section describes the characteristics of the boundary condition, including the application requirements, support limitations, and loading definitions and values.
Dimensional Types
3D Simulation: Supported.
2D Simulation: Supported.
Geometry Types: Geometry types supported for the Radiation boundary condition include:
Solid: Supported.
Surface/Shell: Supported.
Wire Body/Line Body/Beam: Not Supported.
Topology: The following topology selection options are supported for Radiation.
Body: Not Supported.
Face: Supported - 3D Only.
Edge: Supported - 2D Only.
Vertex: Not Supported.
Nodes: Not Supported.
Loading Data Definition : Enter loading data using one of the following options.
Constant: Supported.
Tabular (Time Varying) - for Ambient Temperature: Supported.
Tabular (Spatially Varying): Not Supported.
Tabular (Temperature Varying): Supported for Emissivity if Correlation = Surface To Surface.
Function (Time Varying): Supported.
Function: Not Supported.
The unique loading characteristics and definitions for the Radiation boundary condition are described below.
Ambient Temperature Radiation
When the Correlation property is specified as To Ambient in the Details view of a Radiation object, all of the radiation energy is assumed to be exchanged with the surroundings at ambient temperature, that is, the Form Factor 1 is assumed to be 1.0.
You can set the following additional radiation properties in the Details view:
Emissivity: The ratio of the radiation emitted by a surface to the radiation emitted by a black body at the same temperature.
Ambient Temperature: The temperature of the surrounding space.
Note: 1 Radiation exchange between surfaces is restricted to gray-diffuse surfaces. Gray implies that emissivity and absorptivity of the surface do not depend on wavelength (either can depend on temperature). Diffuse signifies that emissivity and absorptivity do not depend on direction. For a gray-diffuse surface, emissivity = absorptivity; and emissivity + reflectivity = 1. Note that a black body surface has a unit emissivity.
Surface to Surface Radiation
When the Correlation property is specified as Surface to Surface in the Details view of a Radiation object, the radiation energy is exchanged between surfaces. In this context, “surface” refers to a face of a shell or solid body in a 3D model, or an edge in a 2D model. You can then specify Emissivity, Ambient Temperature (defined above), Enclosure, and the Enclosure Type. Emissivity must be a positive value that is not greater than 1. Emissivity can also be defined by Tabular Data.
You should assign the same Enclosure number to surfaces radiating to each other 1 . Specify the Enclosure Type as either (default) or as suited for a simulation of the closed radiation problems. Furthermore, closed radiation problems have no dependence on Ambient Temperature so that property is removed from the Details view during closed problems.
Caution: You cannot apply a Surface to Surface Radiation load to a geometric entity that is already attached to another Radiation load.
When using the Surface to Surface correlation with shell bodies, the Details view also includes a Shell Face setting that allows you the choice of applying the load to Both faces, to the Top face only, or to the Bottom face only.
To apply a Radiation:
On the Environment context toolbar: click Loads>Radiation. Or, right-click the Environment tree object or the Geometry window and select Insert>Radiation.
Define the Scoping Method.
Modify the Ambient Temperature as needed.
The selections available in the Details view are described below.
| Category | Fields/Options/Description |
|---|---|
| Scope |
Scoping Method, options include:
|
| Definition |
Type: Read-only field that displays boundary condition type - Radiation. Correlation Emissivity Ambient Temperature (not visible if Correlation property = and the Enclosure Type property = ) Enclosure (only visible if the Correlation property = ) Enclosure Type (only visible if the Correlation property = ) Note: If a solver error occurs when the Enclosure Type is set to , it is recommended that you change the setting to .
Suppressed: Include ( - default) or exclude () the boundary condition. |
These help sections mention the underlying commands and elements used for implementation of the feature in the Mechanical APDL application. They are presented for reference only. To implement the feature in the Mechanical application, you do not need to interact directly with these commands and elements.
For a perfectly closed system, the VFSM command is employed. Mechanical performs the VFSM,,N,1 command for this boundary condition with Perfect enclosure number N.