You can obtain reaction forces and moments using Force Reaction probes or Moment Reaction probes. At the solver level, the output of reaction forces and moments is controlled via the Mechanical APDL OUTRES command. Support types marked RSOL are governed by the RSOL option, which refers to nodal constraint reactions. Those marked NLOAD and MISC are governed by the NLOAD and MISC options, which refer to the elemental nodal loads and elemental miscellaneous data, respectively. In addition, some analysis and support types require you turn them on in the Output Controls. If no setting is specified for a reaction type, the output occurs automatically.
When you request a Force Reaction or a Moment Reaction in a Cartesian coordinate system at a specific time point by setting Display to Single Time Point in the Details view for Static Structural and Transient Structural Analysis, the Force Reaction or Moment Reaction is displayed by an arrow in the Geometry window. Force Reaction uses a single arrowhead and Moment Reaction uses double arrowhead. The arrows are drawn on the deformed mesh.
Similarly, when the force or moment reaction results are requested based on Frequency or Set Number and Phase Angle for Harmonic analysis or Mode Number for Modal analysis, the base of the arrow of the moment probe is placed at the Summation Point (or "centroid"; the simple calculated average; unweighted by length, area, or volume). However, a Moment Reaction probe whose Location Method is a remote point will place the base of the arrow at the location of the remote point. In this case, there is no detail for Summation Point, and Mechanical does not employ a moment arm calculation. The moments are precisely the nodal moments for the remote point in the result file (as printed by the PRRSOL command in Mechanical APDL).
For those Moment probes which perform a moment arm calculation, Mechanical employs the undisplaced mesh. In other words, when Mechanical computes a moment arm for a node, it finds the difference between the (x,y,z) of the node and the summation point (sx,sy,sz) in the base mesh:
moment_arm = (x,y,z) - (sx,sy,sz)
Note that the above formula differs from how Mechanical APDL performs a moment arm calculation and therefore, the results between the two applications differ. Mechanical APDL uses the FSUM command for large scale deformation analyses (NLGEOM,ON). In Mechanical APDL, node-based displacements, where the NLGEOM,ON command is issued, are added to the (x,y,z) in the base mesh, such that:
moment_arm = (x+ux,y+uy,z+uz) -
(sx,sy,sz)
The following topics discuss each type of reaction, the option that controls the output, and any required setting in the Output Controls. In addition, at the end of the section there is a listing of Support Requirements and Limitations. Make sure you review this content.
For fixed boundary conditions, including:
Face, Edge, and Vertex Rotations (do not include Force reactions)
Displacements for Faces, Edges, and Vertices
Cylindrical Support
Frictionless face
Simply Supported Edge and Vertex
Finite Element (FE) Connection Boundary Conditions (Nodal Displacement and Nodal Rotation)
|
Reaction Type |
Output Controlled By |
|---|---|
|
Static |
The output of these options are controlled by the RSOL option of the OUTRES command. |
|
Transient - Full | |
|
Modal |
The output of these options are controlled by the RSOL option of the OUTRES command. To enable the output, set Calculate Reactions = in the Output Controls. |
|
Harmonic Response - Full | |
|
Harmonic Response - Mode-Superposition |
If results are expanded from a modal solution, then the output of these options are controlled by both the RSOL and NLOAD options of the OUTRES command. You must set both Calculate Reactions and Nodal Forces to either or in the Output Controls. Note: is the preferred option, as the results file size will be smaller and the process time shorter.
Otherwise, the output of these options are controlled by the RSOL option of the OUTRES command. Set Calculate Reactions = in the Output Controls. |
|
Transient - Mode-Superposition | |
|
Response Spectrum |
In the upstream Modal analysis, under the Analysis Settings Output Controls , you must set the Nodal Forces property to either or Constrained Nodes and set the Store Modal Results property to or For Future Analysis. Note: The setting is the preferred setting because the results file size will be smaller and the processing time shorter.
|
|
Random Vibration |
|
Reaction Type |
Output Controlled By |
|---|---|
|
Static |
The output of these options are controlled by the RSOL option of the OUTRES command. |
|
Transient - Full | |
|
Modal |
The output of these options are controlled by the RSOL option of the OUTRES command. To enable the output, set Calculate Reactions = in the Output Controls. |
|
Harmonic Response - Full | |
|
Response Spectrum | |
|
Random Vibration PSD | |
|
Harmonic Response - Mode-Superposition |
If results are expanded from a modal solution, then the output of these options are controlled by both the RSOL and NLOAD options of the OUTRES command. You must set both Calculate Reactions and Nodal Forces to either or in the Output Controls. Note: is the preferred option, as the results file size will be smaller and the process time shorter.
Otherwise, the output of these options are controlled by the RSOL option of the OUTRES command. Set Calculate Reactions = in the Output Controls. |
|
Transient - Mode-Superposition |
|
Reaction Type |
Output Controlled By |
|---|---|
|
Static |
The output of these options are controlled by the RSOL option of the OUTRES command. Reaction probes scoped to a Compression Only boundary condition cannot display results if the solver did not converge. |
|
Transient - Full |
|
Reaction Type |
Output Controlled By |
|---|---|
|
Static |
The output of these options are controlled by the NLOAD option of the OUTRES command. To enable the output, set Nodal Forces = in the Output Controls. |
|
Transient - Full |
|
Reaction Type |
Output Controlled By |
|---|---|
|
Static |
The output of these options are controlled by the RSOL option of the OUTRES command. |
|
Transient - Full |
|
Reaction Type |
Output Controlled By |
|---|---|
|
Static |
The output of these options are controlled by the RSOL option of the OUTRES command. |
|
Transient - Full |
|
Reaction Type |
Output Controlled By |
|---|---|
|
Static |
The output of these options are controlled by the RSOL option of the OUTRES command. |
|
Transient Full | |
|
Modal |
The output of these options are controlled by the RSOL option of the OUTRES command. To enable the output, set Calculate Reactions = in the Output Controls. |
|
Harmonic Response - Full | |
|
Harmonic Response - Mode-Superposition |
If results are expanded from a modal solution, then the output of these options are controlled by both the RSOL and NLOAD options of the OUTRES command. You must set both Calculate Reactions and Nodal Forces to either or in the Output Controls. Note: is the preferred option, as the results file size will be smaller and the process time shorter.
Otherwise, the output of these options are controlled by the RSOL option of the OUTRES command. Set Calculate Reactions = in the Output Controls. |
|
Transient - Mode-Superposition |
|
Reaction Type |
Output Controlled By |
|---|---|
|
Static |
The underlying element options are controlled by the NLOAD option of the OUTRES command. To enable the output, set Nodal Forces = in the Output Controls. The contact element options are governed by the MISC option of the OUTRES command. To enable the output, set Contact Miscellaneous = in the Output Controls. |
|
Transient - Full | |
|
Modal |
These analysis types do not support contact reactions using the contact element option. They only support contact reactions using the underlying element option. You control the underlying element options using the NLOAD option of the OUTRES command. To enable the output, set the Nodal Forces property to in the Output Controls category. |
|
Standalone Harmonic Response - Full | |
|
Standalone Harmonic Response - Mode-Superposition | |
|
Harmonic Response Analysis Linked to Modal Analysis | |
|
Transient - Linked to Modal Analysis |
|
Reaction Type |
Output Controlled By |
|---|---|
|
Static |
The output of these options are controlled by the RSOL option of the OUTRES command. |
|
Transient - Full | |
|
Modal |
The output of these options are controlled by the RSOL option of the OUTRES command. To enable the output, set Calculate Reactions = in the Output Controls. |
|
Harmonic Response - Full | |
|
Harmonic Response - Mode-Superposition |
If results are expanded from a modal solution, then the output of these options are controlled by both the RSOL and NLOAD options of the OUTRES command. You must set both Calculate Reactions and Nodal Forces to either or in the Output Controls. Note: is the preferred option, as the results file size will be smaller and the process time shorter.
Otherwise, the output of these options are controlled by the RSOL option of the OUTRES command. Set Calculate Reactions = in the Output Controls. |
|
Transient - Mode-Superposition |
| Reaction Type | Output Controlled By |
|---|---|
|
Static |
The output of these options are controlled by the RSOL option of the OUTRES command. |
|
Transient - Full | |
|
Modal |
The output of these options are controlled by the RSOL option of the OUTRES command. To enable the output, set Calculate Reactions = in the Output Controls. |
|
Harmonic Response - Full | |
|
Harmonic Response - Mode-Superposition |
If results are expanded from a modal solution, then the output of these options are controlled by both the RSOL and NLOAD options of the OUTRES command. You must set both Calculate Reactions and Nodal Forces to either or in the Output Controls. Note: is the preferred option, as the results file size will be smaller and the process time shorter.
Otherwise, the output of these options are controlled by the RSOL option of the OUTRES command. Set Calculate Reactions = in the Output Controls. |
|
Transient - Mode-Superposition | |
|
Random Vibration |
To enable the output, set Calculate Reactions = in the Output Controls of the upstream Modal analysis. |
|
Response Spectrum |
|
Reaction Type |
Output Controlled By |
|---|---|
|
Static |
The output of these options are controlled by the NLOAD option of the OUTRES command. To enable the output, set Nodal Forces = in the Output Controls. |
|
Transient - Full | |
| Modal | |
| Transient - Mode-Superposition |
|
Reaction Type |
Output Controlled By |
|---|---|
|
Static |
The underlying element options are controlled by the NLOAD option of the OUTRES command. To enable the output, set Nodal Forces = in the Output Controls.
Note: Mechanical supports geometry scoping for vertices, edges, and faces only.
|
|
Transient - Full |
Note: A limitation exists when the scoping of a Force Reaction or Moment Reaction probe is applied to a geometry entity (Location Method = ) that shares more than one body. The (unscoped) elements that are adjacent to the scoped body contribute to the probe's results.
|
Reaction Type |
Output Controlled By |
|---|---|
|
Static |
The output of these options are controlled by the NLOAD option of the OUTRES command. To enable the output, set Nodal Forces = in the Output Controls. |
|
Transient - Full | |
| Transient - Mode-Superposition |
Force Reaction probes support Cartesian or cylindrical coordinate systems. Moment Reaction probes support Cartesian coordinate systems only.
A Moment Reaction probe cannot be scoped to a Grounded Spring.
For the Moment Reaction probe, the Summation property is available for most Location Method property selections and enables you to select or for your scoped entity. If your selected Location Method does not display this property, the application automatically uses the centroid of the scoped entity for the moment calculation.
A reported reaction may be inappropriate if that support shares a face, edge, or vertex with another support, contact pair, or load. This is because the underlying finite element model will have both loads and supports applied to the same nodes.
If a model contains two or more supports that share an edge or vertex, use caution in evaluating the listed reaction forces at those supports. Calculation of reaction forces includes the force acting along bounding edges and vertices. When supports share edges or vertices the global summation of forces may not appear to balance. Reaction forces may be incorrect if they share an edge or face with a contact region.
For a Moment Reaction scoped to a contact region, the location of the summation point may not be exactly on the contact region itself.
If you set Extraction equal to Contact (Underlying Element) or Target (Underlying Element) in the Details view of either a Force Reaction or Moment Reaction probe, the reaction calculations work by summing the internal forces on the underlying elements under a contact region. These probes can also extract reaction data from surface effect elements. The application creates surface effect elements during the solution process to simulate loads, such as pressures. However, the application does not currently display surface effect elements from the Mesh object or the Connections object.
Therefore, a reported reaction may be inappropriate on a contact face if that face shares topology with another contact face/edge or external load (such as a force or fixed support), which would contribute to the underlying elements' internal force balance. In addition, during a Transient analysis, inertial and damping forces are also included. Another possible scenario could arise for MPC contact of solid surfaces. In this case, if a gap is detected, the solver may build constraints on an additional layer into the solid mesh from the TARGET elements. This produces a more accurate response but will invalidate any reactions from the underlying solid elements of the TARGET elements. If symmetric contact is chosen, be careful to verify which side becomes active for the TARGET elements so that the correct reaction can be determined.
When scoping Force Reaction or Moment Reaction probes to geometry, it is possible that there may be elements (and as a result, element-based reactions) that are currently unavailable for summing purposes. For example, you scope a pressure to a face on your geometry. The solution process also applies surface effect elements to the same face to simulate the pressure loading. The probes, scoped to geometry, currently cannot extract reaction data from the surface effect elements and therefore, in the case of this example, only the underlying solid/shell/line elements of the original mesh contribute reaction data to the probe results.
For Modal analysis, reaction results in damped modal analysis provide a By field option in the result definition to compute results based on Mode Number, Phase of Maximum, and Maximum Over Phase.
For a Harmonic Response analysis, reaction results support all options of the result definition available for other harmonic results, and are reported based on the nearest frequency results available; no interpolation is done.
In order to evaluate reactions successfully for a standalone Mode Superposition Harmonic Response analysis that has the Clustering property set to , you need to also make sure that either the Stress, Strain, Nodal, or the General Miscellaneous properties in the Analysis Settings>Output Controls are also set to .
Reaction results sweep through a phase period of 0o and 360o at a specified increment. In previous releases of Mechanical (14.5 and earlier), the default value for this increment was 1o in order to determine the Phase of Maximum and the Maximum Over Phase values. For Harmonic Response analyses only, the phase increment can be controlled using the Phase Increment option. A Phase Increment entry can be between 1o and 10o. The default Phase Increment value is 10o but for legacy database results it is 1o.
For Random Vibration and Response Spectrum analysis, reaction results can only be scoped to a Remote Displacement boundary condition. Animation of reaction results is not supported for modal and harmonic analysis.
Since Beam Connections are, by definition, three dimensional in nature, the reactions object scoped to grounded beams may produce reactions in all three directions/axes for two-dimensional analysis. The Tabular Data view will reflect the reactions in all three axes, while the Results view will only reflect values in two axes. The total reactions will be calculated taking into account the reaction components in all three axes.
For a force reaction scoped to a contact region, if you set Extraction = Contact (Contact Element), the reaction calculations come directly from the contact elements themselves. This results in accurate force reactions even when the contact region overlaps with other boundary conditions, such as other contact regions, supports, etc. Characteristics of the setting are that MPC contact is not supported, nor are reactions from the Target (Underlying Element) side. This feature should only be used with Asymmetric contact and requires that Contact Miscellaneous be set to Yes in the Output Controls. A limitation of the Contact (Contact Element) setting is when you use linear contact (that is, either Bonded or No Separation contact types) with loads that are unrealistically very high or very low in magnitude. These situations can produce inaccurate force reactions.
Furthermore, in certain rare cases that involve large or concentrated initial interference and/or thermal expansion applications, the reactions calculated by the contact element option may differ from those calculated by the underlying elements. If you experience such as scenario, the underlying element approach is more accurate. Try to tighten the tolerances of the Newton-Raphson Option property under the Nonlinear Controls category of the Analysis Settings (also see the CNVTOL command) to improve the contact element reaction calculations.
When a probe is scoped to a Mesh Connection, the Mechanical application reports the following reactions:
Forces and Moments summed from the element nodal forces and moments in the result file.
The Extraction detail determines which elements (Master or Slave) contribute to the force or moment sum.
The Surface Location Method enables you to study reactions on cutting planes. You can extract generated member forces and reactions through a model by using a reaction probe scoped to a . For this probe type, you must explicitly select the body or bodies (via the Geometry property) to be sliced. You then specify for the Extraction property based upon whether you want to study the nodes in front or behind the plane. The Force Reaction probe operates the on elements cut by the plane (and only nodes on those elements which are on the selected side of the plane). Currently, surface probes cannot intersect a plane strain or an axisymmetric model and consequently no results display for this scoping.
Important: Do not apply reaction probes to cutting planes that intersect a boundary condition because the reported reactions become unreliable.
Note: Surfaces used in reaction probes do not currently intersect all geometries, such as line bodies, joints, springs, and MPC contact.