Remote Force

A Remote Force is equivalent to a regular force load on a face or a force load on an edge, plus some moment.

A Remote Force can be used as an alternative to building a rigid part and applying a force load to it. The advantage of using a remote force load is that you can directly specify the location in space from which the force originates.

A Remote Force is classified as a remote boundary condition. Refer to the Remote Boundary Conditions section for a listing of all remote boundary conditions and their characteristics.

A Remote Force can be applied to a face, edge, or vertex of a 3D model, or to an edge or vertex of a 2D model.

Analysis Types

Remote Force is available for the following analysis types:

Common Characteristics

This section describes the characteristics of the boundary condition, including the application requirements, support limitations, and loading definitions and values.

Dimensional Types

Geometry Types: Geometry types supported for the Remote Force boundary condition include:

Topology: The following topology selection options are supported for Remote Force.

Loading Types: The boundary condition’s loading is defined using one of the following options.

Loading Data Definition : Enter loading data using one of the following options.

Boundary Condition Application

You apply a Remote Force as you would apply a force load except that the location of the load origin can be replaced anywhere in space either by picking or by entering the XYZ locations directly or by scoping a geometric entity using the Location property. Note that when you first define the properties of the Remote Force, the application automatically sets the default location of the Location property at the centroid of the scoped geometry selection(s). This setting is maintained even if you re-specify your geometry scoping. It is necessary to manually change the Location property's definition.

The location and the direction of a remote force can be defined in the global coordinate system or in a local coordinate system.

To apply a Remote Force:

  1. On the Environment context toolbar: click Loads>Remote Force. Or, right-click the Environment tree object or the Geometry window and select Insert>Remote Force.

  2. Define the Scoping Method.

  3. Select geometric entities on your model.

  4. Specify a coordinate system as needed. The default selection is the Global Coordinate System. You can also specify a user-defined or local coordinate system.

  5. Select the method used to define the remote force: Vector (default), Vector: Real - Imaginary, Components, or Components: Real - Imaginary.

  6. Define the Magnitude, Coordinate System directional loading, and/or Direction of the load based on the above selections.

  7. For Harmonic analyses, specify a Phase Angle as needed.

  8. Select the Behavior of the geometry.

  9. As needed, enter a Pinball Region value. The default value is All.

Details View Properties

The selections available in the Details view are described below.

CategoryFields/Options/Description
Scope Scoping Method, options include:
  • Geometry Selection: Default setting, indicating that the boundary condition is applied to a geometry or geometries, which are chosen using a graphical selection tools.

    • Geometry: Visible when the Scoping Method is set to Geometry Selection. Displays the type of geometry (Body, Face, etc.) and the number of geometric entities (for example: 1 Body, 2 Edges) to which the boundary has been applied using the selection tools.

  • Named Selection: Indicates that the geometry selection is defined by a Named Selection.

    • Named Selection: Visible when the Scoping Method is set to Named Selection. This field provides a drop-down list of available user–defined Named Selections.

  • Remote Point: Indicates that the geometry is defined by a Remote Point.

    • Remote Points: This field provides a drop-down list of available user-defined Remote Points.

Coordinate System: Drop-down list of available coordinate systems. Global Coordinate System is the default.

The following properties are used to define the location of the load’s origin:

  • X Coordinate

  • Y Coordinate

  • Z Coordinate

Location: This property specifies the location of the load's origin. The default location is the centroid of your geometry selection(s). You can define this property manually using geometry entity selections as well as by making entries in the above coordinate properties.

Definition

Type: Read-only field that displays boundary condition type - Remote Force.

Define By, options include:

  • Vector: A magnitude and direction (based on selected geometry). Requires the specification of the following inputs:

  • Vector: Real - Imaginary (Harmonic Analysis only): Real and imaginary magnitude and direction (based on selected geometry). Requires the specification of the following inputs:

    • Magnitude - Real

    • Magnitude - Imag

    • Direction

  • Components: Option to define the loading type as Components (in the world coordinate system or local coordinate system, if applied). Requires the specification of at least one of the following inputs:

    • X Component: Defines magnitude in the X direction.

    • Y Component: Defines magnitude in the Y direction.

    • Z Component: Defines magnitude in the Z direction.

    • X Phase Angle (Harmonic Analysis only)

    • Y Phase Angle (Harmonic Analysis only)

    • Z Phase Angle (Harmonic Analysis only)

  • Components: Real - Imaginary (Harmonic Analysis only): Option to define the loading type as real and imaginary components (in the world coordinate system or local coordinate system, if applied). Requires the specification of at least one of the following inputs:

    • X Component - Real

    • X Component - Imaginary

    • Y Component - Real

    • Y Component - Imaginary

    • Z Component - Real

    • Z Component - Imaginary

Note:  Selection of a Coordinate System rotated out of the global Cartesian X-Y plane is not supported in a 2D analysis.

Suppressed: Include (No - default) or exclude (Yes) the boundary condition.

Behavior : This option dictates the behavior of the attached geometry. If the Scope Method property is set to Remote Point, the boundary condition will then assume the Behavior defined in the referenced Remote Point as well as other related properties. Options include:

  • Rigid: Does not allow the scoped geometry to deform. This is the only available option for Explicit Dynamics analyses.

  • Deformable: Allows the scoped geometry to deform.

  • Coupled: Allows the scoped geometry to have the same DOF solution on its underlying nodes as the remote point location.

  • Beam: This option specifies a connection from the remote load to the model using linear massless beam elements. It is not a valid option for a Modal Superposition Harmonic Response analysis unless a Remote Point references the load.

Material: This property is available when the Behavior property is set to Beam. Select a material to define material properties for the beams used in the connection. Density is excluded from the material definition.

Radius: This property is available when the Behavior property is set to Beam. Specify a radius to define the cross section dimension of the circular beam used for the connection.

Follower Load (Rigid Dynamics analysis only): When set to No (default), the force direction doesn't change during the simulation. When set to Yes, the force direction is updated with the underlying body.

Advanced Pinball Region: Modify the Pinball setting to reduce the number of elements included in the solver.

Note:  The Pinball Region property is not supported for the Samcef and ABAQUS solvers.


Release 18.2 - © ANSYS, Inc. All rights reserved.