Rotational Velocity

Rotational velocity accounts for the structural effects of a part spinning at a constant rate.

Analysis Types

Rotational Velocity is available for the following analysis types:


Note:
  • For a Transient Structural analysis that is linked to a Modal Analysis, Rotational Velocity is an invalid boundary condition in the Transient Structural analysis.

  • For a Modal Analysis, Rotational Velocity is valid only when the following Analysis Settings properties are specified:

  • If Rotational Velocity is defined in a Static Structural analysis, the spin softening effect is automatically included in rotating reference frame dynamics (Coriolis Effect set to Off in the Rotordynamics Controls group). This may lead to negative or zero frequencies in a downstream perturbed Modal Analysis. This does not apply to stationary reference frame dynamics (Coriolis Effect set to On).


Common Characteristics

This section describes the characteristics of the boundary condition, including the application requirements, support limitations, and loading definitions and values.

Dimensional Types

Geometry Types: Geometry types supported for the Rotational Velocity boundary condition include:

Topology: The following topology selection options are supported for Rotational Velocity.

Body: Supported. The following requirements must be met or the application will invalidate your load:

Loading Types: The boundary condition's loading is defined using one of the following options.

Loading Data Definition : Enter loading data using one of the following options.

Boundary Condition Application

To apply rotational velocity to all bodies, in the Details view, accept the default Geometry setting of All Bodies.

To apply rotational velocity to selected bodies, in the Details view, set Scoping Method to either Geometry Selection or Named Selection, then either select the bodies in the Geometry window (hold down the Ctrl key to multiple select) or select from the list of the Named Selections available in the Details view.

To apply additional rotational velocity loads, you must have applied the original load to selected bodies, per above, not to All Bodies.

To apply a Rotational Velocity:

  1. On the Environment context toolbar: click Inertial>Rotational Velocity. Or, right-click the Environment tree object or the Geometry window and select Insert>Rotational Velocity.

  2. Select a Scoping Method.

  3. Select the method used to define the Rotational Velocity: Vector (default) or Components.

  4. Define the Magnitude, Component values, Coordinate System, and/or Direction of the Rotational Velocity based on the above selections.

Details View Properties

The selections available in the Details view are described below.

CategoryFields/Options/Description
Scope

Scoping Method, options include:

  • Geometry Selection: Default setting, indicating that the boundary condition is applied to a geometry or geometries, which are chosen using a graphical selection tools.

    • Geometry: Visible when the Scoping Method is set to Geometry Selection. Displays the type of geometry (Body) and the number of geometric entities (for example: 1 Body, 2 Bodies) to which the boundary has been applied using the selection tools.

  • Named Selection: Indicates that the geometry selection is defined by a Named Selection.

    • Named Selection: Visible when the Scoping Method is set to Named Selection. This field provides a drop-down list of available user–defined Named Selections.

Definition

Define By (In a cyclic symmetry analysis, the Rotational Velocity must be defined by components.), options include:

  • Vector: A magnitude and directional axis (based on selected geometry). Requires the specification of the following inputs:

    • Magnitude

    • Axis

  • Components: Requires the specification of the following inputs:

    • Coordinate System: Drop-down list of available coordinate systems. Global Coordinate System is the default. When using cyclic symmetry, the referenced coordinate system must match coordinate system used in the Cyclic Region. The referenced coordinate system must be Cylindrical.

    • X Component: Defines magnitude in the X direction.

    • Y Component: Defines magnitude in the Y direction.

    • Z Component: Defines magnitude in the Z direction.

    • X Coordinate

    • Y Coordinate

    • Z Coordinate


Note:

In a Modal analysis:

  • With multiple solve points (Campbell Diagram turned On), the magnitude or the resultant of the components must be in ascending order.

  • When specified by Components, only the Global Coordinate System is available (the option is read-only).


Suppressed: Include (No - default) or exclude (Yes) the boundary condition.

Mechanical APDL References and Notes

The following Mechanical APDL commands and considerations are applicable for this boundary condition.


Release 18.2 - © ANSYS, Inc. All rights reserved.