Solution Combinations

You can create solutions that are calculated from other solutions. These are derived from the addition of results coming from one or more environments, each of which can include a multiplication coefficient that you supply. Included are nonlinear results, which are a simple addition of values. The calculated values cannot be parameterized.

Only Static Structural analyses are available for solution combination selections.

The Design Assessment system provides a more powerful Solution Selection capability, allowing you to combine results from a greater variety of upstream analysis systems and perform additional post processing functions using external scripts.


Note:
  • Choosing Update Project from the Project Schematic will not solve a Solution Combination in the Mechanical application.

  • If you have multiple result objects specified under the Solution Combination folder that are scoped to individual, and different, bodies, and these results have the Average Across Bodies property set to Yes, the application automatically calculates the average across all of the (different) scoped bodies. This is in contrast to how the application normally calculates the average across bodies. Wherein, the application calculates the average across the specified body only.


To Create a Solution Combination Object You can insert one or more Solution Combination objects under the Model object. Under the Solution Combination object, you can add the following results types:

Each solution object contains its own configuration spreadsheet, available through the Worksheet View.

When setting up a Solution Combination, you select the Environment Objects you wish to add together from a drop-down list of all available environments. At least one environment must be checked. Enter the multiplication coefficient you wish for each environment.

The results values shown for these objects are derived from the same results objects in the referenced environments, including any defined multiplication coefficients. The basic formula for calculating the results is:

(multiplication coefficient 1 X value from environment 1) + (multiplication coefficient 2 X value from environment 2) + etc.


Note:  You can specify a coordinate system in the Details view of the Solution item for which you request a solution combination. The default is the Global Cartesian Coordinate system. The solution item at each result set identified in the Worksheet view is calculated in the specified coordinate system and then solution combination is carried out.

If you request solution combination for derived quantities such as equivalent/principal stresses as well as total displacement, the following two step procedure is used:

  1. Solution combination is carried out to compute component results first.

  2. The requested result items are then derived from the components.

In addition:

  • Equivalent strains (including elastic, thermal, plastic, creep, total, and total plus thermal equivalent strains) are read from the result file and are used directly in the linear combination formulation. The component strains (X, Y, Z, XY, YZ, XZ) are not used. This procedure is similar to using the Mechanical APDL SUMTYPE,PRIN command.

  • Using the equivalent strains from the result file may lead to unexpected (or even negative) results.



Release 18.2 - © ANSYS, Inc. All rights reserved.