You can automatically generate supported connections for a group of bodies in a model and use a separate tolerance value for that group. The supported connection types are Contact Region and Joint .
To automatically generate connections for a group of bodies:
Insert a Connection Group object under the Connections folder either from the toolbar button or by choosing from the context menu (right mouse click) for this folder.
From the Details view of the Connection Group object, select the desired Connection Type. The default is Contact.
Select some bodies in the model based on the Scoping Method. The default is Geometry Selection scoped to All Bodies.
If applicable, set the Auto Detection properties. Note that these properties will be applied only to scoped geometries for this connection group.
Choose from the context menu (right mouse click) for the Connection Group.
Note: For small models, the auto contact detection process runs so fast that the Contact Detection Status (progress bar) dialog box does not get displayed. However, for large models with many possible contact pairs, the progress bar dialog box is displayed showing the contact detection progress. If you click the button on the dialog box while contact detection is processing, the detection process stops. Any contact pairs found by that moment are discarded and no new contacts are added to the tree.
The resulting connection objects will be placed under this folder and the folder name will be changed from its default name Connection Group to a name based on the connection type. The folder name for contacts will be Contacts and for joints it will be Joints. Once the Connection Group folder contains a child object, the Connection Type property cannot be changed. Each Connection Group folder will hold objects of the same type and will include a worksheet that displays only content pertaining to that folder. When two or more Connection Group folders are selected and you choose , auto detection for the selected Connection Group folders will be performed. The option is also available from the context menu (right mouse click) for the Connections folder provided there is at least one Connection Group folder present. When you choose this command from the Connections folder, auto detection will be performed for all connection groups under this folder.

You can insert any supported connection objects manually either from the toolbar or by choosing from the context menu (right mouse click) on the Connections or Connection Group folder. When inserting a connection object from the Connections folder, a Connection Group object will automatically be created in addition to the connection object itself. When inserting a connection object from a Connection Group folder, if it is an empty folder, any supported type of object can be inserted. However, if the folder already contains at least one object, only objects of the same type can be inserted.
Overlapping contact conditions arise when a face or edge is contained in more than one Contact Region. Mechanical supports this situation for the Mechanical APDL Solver; however, if your analysis is incorporated into a fluid analysis, issues can arise.
Mechanical provides the context menu option Check Overlapping Contact Regions to identify any overlapping contact regions in your model so that you can address them appropriately.
Generating connections (Contacts or Joints) and Mesh Connections , either automatically or manually, may result in the same geometry pair being scoped by more than one connection object. This may over constrain the model which may lead to convergence difficulty problems in the solver. If this situation occurs, you can take corrective action by modifying the geometry scoping of the duplicated pairs or by deleting the duplicate connection objects.
In order to assist with this corrective action the feature is useful. Select the connection object and from the context menu select the option. This will check against existing connection objects for possible duplicate pairs. If one or more duplicate pairs are found in the existing connection objects (which includes Mesh Connections), the following warning message will appear in the Messages pane for a connection object that shares the same geometry pair:
"This connection object shares the same geometries with one or more connection objects. This may over-constrain the model. Consider eliminating some connection objects."
To search for connection objects that share the same geometry pair with more than one connection object, select multiple connection objects before selecting . Or you may issue the search from a Connection Group or Mesh Connection Group folder, where the search will be carried out for all connection objects under this folder. When this command is issued from the Connections folder or the Mesh Connections folder, the search will be for the entire set of connection objects under these folders.
Once the duplicates have been detected, the resulting messages can then be used. To find the connection object for a particular message, highlight that message in the Messages pane, right-click that message, and choose from the context menu. The connection object will be highlighted in the tree. In order to find other connection objects that share the same geometry pair, right-click the highlighted object and select from the context menu; all connection objects that share the same geometry pair will be highlighted in the tree.
To move a connection object to another folder of the same connection type, drag the object and drop it on that folder. For example, to move a contact region object, drag the object from its current Contacts folder and drop it on another folder whose Connection Type is Contact (possibly named Contacts 2).
To copy a connection object to another folder of the same connection type, hold the Ctrl key while performing the move procedure described above.
You can create contact sizing controls automatically by:
Dragging and dropping the Contacts folder onto the Mesh object to create a Contact Sizing control for each contact region in the folder.
Selecting the Contacts folder or an individual Contact Region in the Tree and using the RMB option Create > Contact Sizing to create Contact Sizing controls for the selected contact regions.
Supported connection objects from databases of previous versions of ANSYS Workbench will be grouped based on their types and migrated into Connection Group folders.