Condensed Part Application

This section describes the steps to create and define Condensed Part objects in a Rigid Dynamics analysis. You should review all of the associated documentation so that you understand the application-driven actions that take place as well as the inherent limitations of the feature.

The operation of condensing parts in Mechanical is largely automated. For example, Mechanical provides facilities that analyze the connectivity of the bodies in the model and group them into Condensed Parts. Connections are classified as interior or exterior (interfaces).

Application

To create a Condensed Part:

  1. Import your model into a Rigid Dynamics analysis.

  2. As needed, create and define your interfaces/connections (Joints, Springs, Point Mass, Remote Points, and/or Contacts).

  3. Open the Geometry folder and specify the desired connected parts as Flexible. These parts will be converted to Condensed Parts.

  4. Select the Model object and then select the Condensed Geometry option on the toolbar, or you can right-click the Model object and select Insert>Condensed Geometry. A Condensed Geometry object is placed in the tree and a Condensed Geometry toolbar displays.


    Note:  The application automatically inserts the Expansion Settings object under the Solution folder when a Condensed Geometry object is created.


  5. Once the Condensed Geometry object is placed in the tree, the following context menu (right-click) options become available:

    • Generate Condensed Parts

    • Create Automatic Condensed Parts

    You can create your condensed parts using Create Automatic Condensed Parts, or you can select the Condensed Part option on the toolbar, or you can right-click the Condensed Geometry object and select Insert>Condensed Part. A Condensed Part object is placed in the tree.

    The application provides two automatic methods for defining interfaces for a Condensed Part using the context menu (right-click) options:

    • Create Automatic Condensed Part: this option selects the bodies and detects the interfaces and defines new Condensed Part objects.

    • Detect Condensed Part Interface: this option automatically suggests interfaces. This is especially useful should you prefer a more granular distribution of bodies into Condensed Parts. This is especially useful should you manually select bodies for your Condensed Parts for greater granularity.


    Note:  The Condensed Part object displays the number of superelement master nodes resulting from interfaces in the Details view.


    See the object reference pages for Condensed Geometry and Condensed Part for descriptions of all associated Details view properties.

  6. Insert desired results. This feature supports Deformation, Stress, and Strain results.

  7. Solve the analysis.

  8. As desired, you can obtain results in the original elements within the Condensed Part by selecting the Expansion Settings object and displaying the Worksheet. Select desired Condensed Part(s).

    It is possible to add or remove interfaces directly on the Interfaces Worksheet using its context menus. This is especially useful for specifying new remote interfaces not already automatically detected. Mechanical attempts to verify all interface selections during the Generation and Use Passes and issues a warning should any be missing. Mechanical also tracks operations that remove and suppress upstream objects affecting the interface and reacts accordingly.


Note:  To delete a Condensed Geometry object, it is necessary to clean and remove any generated Condensed Parts. Similarly, to delete an Expansion Settings object, it is necessary to clean any generated data.



Release 18.2 - © ANSYS, Inc. All rights reserved.