Fracture Meshing

The Meshing application supports fracture meshing capabilities enabling you to insert multiple surface cracks into a mesh. These fracture meshes can then be used to analyze crack fronts in static structural and transient structural analyses. Fracture meshing uses a Fracture object that can contain multiple Semi-Elliptical Crack and/or Arbitrary Crack objects.

For Semi-Elliptical cracks, the Mesh Method property specifies that the mesh be Hex Dominant (default) or Tetrahedrons.

The following figure illustrates many of the components of fracture meshing that are discussed throughout this section. This figure is a sliced top view of a semi-elliptical crack.

Overview of Fracture Meshing Components

  1. Body to which the semi-elliptical crack is scoped.

  2. Base mesh, which always consists of quadratic tetrahedron elements. For the generation of fracture mesh, the base mesh inside and surrounding the region of the buffer zone (3) must be a quadratic tetrahedron mesh. However, non-tetrahedron/linear mesh may exist farther away from the buffer zone on the same body to which the semi-elliptical crack is scoped.

  3. Buffer zone, which is always filled with quadratic tetrahedron elements.

  4. Interface between the buffer zone (3) and the fracture affected zone (5), illustrated by the green line. Contact pair 1 is defined at the interface between the elements in the buffer zone and the elements in the fracture affected zone.

  5. Fracture affected zone, which is filled with quadratic elements (hex and wedge).

  6. Crack front, located along the crack shape and illustrated by the red line. The crack shape is semi-elliptical.

  7. Discontinuity planes, illustrated by the light blue shading. Consist of two planes at the same location (the crack front plane).


Note:  When you specify the Mesh Method property as Tetrahedrons to mesh a Semi-Elliptical Crack, the application does not create the Fracture Affected Zone (Step 5) and as a result the Interface (Step 4) does not exist. All other components remain the same.


Characteristics and Limitations of Fracture Meshing

Remember the following information when using fracture meshing:


Release 18.2 - © ANSYS, Inc. All rights reserved.