Harmonic Acoustics analyses are used to determine the steady-state response of a structure and the surrounding fluid medium to loads and excitations that vary sinusoidally (harmonically) with time. Examples of harmonic acoustics include Sonar (the acoustic counterpart of radar), the design of concert halls, the minimization of noise in a machine shop, noise cancellation in automobiles, audio speaker design, speaker housing design, acoustic filters, mufflers, and Geophysical exploration. Typical quantities of interest in the fluid and far-field location at different frequencies are pressure distribution, pressure gradient, sound power, and particle velocity of acoustic waves.
In Harmonic Response analyses, the following equation is resolved for pure acoustic problems:
For fluid structure interaction problems, the acoustic and the structural matrices are coupled using the following equation:
The Harmonic Acoustics environment provides the following context menu (right-click) options:
> : This selection creates a Fluid Solid Interface object with all possible Fluid Solid Interface face selection based on the physics region definitions.
> : This selection automatically creates an Far-Field Radiation Surface object that includes all possible Equivalent Source (Maxwell) Surfaces available in the analysis. Mechanical identifies the following faces as equivalent source (Maxwell) surfaces:
Interface between the normal acoustic element and PML acoustic element (Interface between Normal Acoustic and PML Acoustic Region)
Face selections of Radiation Boundary (faces of elements flagged with SF ,,INF)
Face selections of Impedance Boundary (faces of element flagged with SF ,,IMPD)
Face selection of Absorption Element (faces of elements of type FLUID130)
Face selection of Absorption Surface (faces of element flagged with SF ,,ATTN)
> : This selection performs both of the above object generation options.
>
>
Create Analysis System
Basic general information about this topic
... for this analysis type:
If you have not already created a Harmonic Acoustics system in the Project Schematic, see the Harmonic Acoustics section in the Workbench User's Guide for the steps to create this system.
Define Engineering Data
Basic general information about this topic
... for this analysis type:
All the acoustic bodies must be assigned a material containing Density and Speed of Sound.
Important: Air, Water Liquid, and Water Vapor from the Fluid Materials include the Speed of Sound property. Any other material to be used in the Acoustics Region requires you to specify the Speed of Sound from the Toolbox > Physical Properties category of Engineering Data workspace.
Define Part Behavior
Basic general information about this topic
... for this analysis type:
A Structural Physics Region may contain bodies with the Stiffness Behavior set to . Acoustics Regions do not support a Stiffness Behavior setting of .
If the Structural Region has the Stiffness Behavior property set to and if it is in contact with acoustic regions, then fluid-structure interaction may not behave as expected.
Define Connections
Basic general information about this topic
... for this analysis type:
There are no specific contact considerations for this analysis.
Apply Mesh Controls/Preview Mesh
Basic general information about this topic
... for this analysis type:
There are no specific mesh considerations for a harmonic acoustics analysis.
Establish Analysis Settings
Basic general information about this topic
... for this analysis type:
For a Harmonic Acoustics analysis, the basic Analysis Settings include:
- Options
The Options category enables you to specify the frequency range and the number of solution points at which the harmonic analysis will be carried out as well as the solution method to use and the relevant controls.
Only the Direct Integration (Full) Solution Method is available to perform a Harmonic Acoustics analysis.
- Scattering Controls
The Scattering Controls category includes the Scattered Field Formulation property. The options for this property include:
(default)
: Selecting this option turns scattering controls off.
: Selecting this option turns scattering controls on and also displays the Scattering Output Type property.
The Scattering Output Type property is used to specify the output type for an acoustic scattering analysis. The options for this property include and . Select the Total option when you wish to output the total pressure field and the option when you want to output the scattered pressure field.
If you specify an Incident Wave Source excitation and also specify the Incident Wave Location property as , then the application uses the setting for the Scattering Output Type property only.
For more information, refer to the ASOL and ASCRES commands in the Mechanical APDL Command Reference.
- Advanced
The Advanced category includes the property Far-Field Radiation Surface. Far-field result calculations are based on the Equivalent Source (Maxwell) Surfaces. Therefore, this field controls far-field result definitions and results. The options include:
(default): If your analysis does not include a user-defined Far-Field Radiation Surface boundary condition object, this setting identifies the Equivalent Source (Maxwell) Surfaces automatically created by the application using the environment option > . In this case, the application applies the surface flag MXWF on them. If the analysis does include a user-defined Far-Field Radiation Surface object, this settings defined by that object are used.
: This option requires the definition of at least one user-defined Far-Field Radiation Surface object.
: This setting invalidates all Equivalent Source (Maxwell) Surface objects and Far Field Result objects.
- Output Controls
For Acoustic Region:
By default, the application calculates Acoustic Pressure. You can also request Acoustic Velocity and Acoustic Energy.
For Structural Region:
Additional Output Controls are available when solving an FSI problem in order to control the results calculated on structural domain. By default, only deformations are calculated. You can request Stress and Strain results. You can also specify to Calculate Reactions.
- Damping Controls
The Damping Controls category is visible when Structural Physics is turned on. These properties enable you to specify damping for the structure in the Harmonic Acoustics analysis. Controls include: Structural Damping Coefficient, Stiffness Coefficient (beta damping), and a Mass Coefficient (alpha damping). They can also be applied as Material Damping using the Engineering Data tab.
Element Damping: You can also apply damping through spring-damper elements. The damping from these elements is used only in a Full method harmonic analysis.
Important: If multiple damping specifications are made the effect is cumulative.
- Analysis Data Management
These properties enable you to save solution files from the harmonic analysis. The default behavior is to only keep the files required for postprocessing. You can use these controls to keep all files created during solution or to create and save the Mechanical APDL application database (db file).
Define Physics Region(s)
Basic general information about this topic
... for this analysis type:
To create a Physics Region:
Highlight the Environment object and select the Physics Region button on the Environment toolbar or right-click the Environment object or within the Geometry window and select > .
Define all of the properties for the new object. For additional information, see the Physics Region object reference section.
A Structural Physics Region may contain bodies with the Stiffness Behavior set to . Acoustics Regions do not support a Stiffness Behavior setting of .
If the Structural Region has the Stiffness Behavior property set to and if it is in contact with acoustic regions, then fluid-structure interaction may not behave as expected.
Apply Loads and Supports
Basic general information about this topic
... for this analysis type:
The following loading conditions are supported for this analysis type:
Inertial
Acceleration
Acoustic Excitations
Mass Source Surface Velocity Diffuse Sound Field Incident Wave Source Port in Duct
Acoustic Loads
Temperature Impedance Sheet Static Pressure
Acoustic Boundary Conditions
Pressure Impedance Boundary Absorption Surface Radiation Boundary Absorbing Element Free Surface Thermo-Viscous BLI Boundary Rigid Wall Symmetry Plane Far-Field Radiation Surface
Acoustic Models
Transfer Admittance Matrix
The following loading conditions are supported if the analysis has structural physics:
Loads
Pressure Force Remote Force Moment Line Pressure Fluid Solid Interface: Use the option on the Environment context menu to auto generate the applicable Fluid Solid Interfaces.
Supports
Fixed Support Displacement Remote Displacement Frictionless Support Compression Only Support Cylindrical Support Elastic Support
Conditions
Constraint Equation
Direct FE
Nodal Orientation Nodal Force Nodal Displacement
Solve
Basic general information about this topic
... for this analysis type:
The Solution Information object provides some tools to monitor solution progress.
Solution Output continuously updates any listing output from the solver and provides valuable information on the behavior of the model during the analysis. Any convergence data output in this printout can be graphically displayed as explained in the Solution Information section.
Review Results
Basic general information about this topic
... for this analysis type:
You can scope most of the Harmonic Acoustic analysis results to entities on acoustic bodies and, by default, all acoustic bodies compute results for display.
Additional results are available for structural domain when solving Fluid Structural Interaction (FSI) problems. Refer to the Review Results section of Harmonic Response Analysis for more information regarding how to set up the harmonic results.