Create Analysis System
Basic general information about this
topic
... for this analysis type:
Because this analysis is linked to (or based on) modal responses, a Modal analysis is a prerequisite. This setup allows the two analysis systems to share resources such as engineering data, geometry and boundary condition type definitions made in modal analysis.
Note:
The Mode-Superposition harmonic is allowed to be linked to a pre-stressed modal analysis.
When solving a linked MSUP harmonic system database from a version prior to the most current version of Mechanical, it is possible to encounter incompatibility of the file file.full created by the modal system. This incompatibility can cause the harmonic system’s solution to fail. In the event you experience this issue, use the feature and resolve the modal system.
Refer to the Obtain the Mode-Superposition Harmonic Solution section of the MAPDL Structural Analysis Guide for more information.
From the Toolbox, drag a Modal template to the Project Schematic. Then, drag a Harmonic Response template directly onto the Solution cell of the Modal template.
Establish Analysis Settings
Basic general information about this
topic
... for this analysis type:
For this analysis configuration, the basic Analysis Settings include:
- Options
See the Harmonic Analysis Options Group section for a complete listing of the Details properties for a Harmonic Response analysis. Note that for a Harmonic Analysis Using Linked Modal Analysis System, only the Mode-Superposition option is applicable, and therefore is read-only. In addition, you can turn the Include Residual Vectors property to execute the RESVEC command and calculate residual vectors. Also, Mode Frequency Range is not applicable because available modes are defined in the linked Modal system.
Note: The following boundary conditions do not support residual vector calculations:
Nodal Force
Remote Force scoped to global a Remote Point (created via Model object)
Moment scoped to global a Remote Point (created via Model object)
- Output Controls
This category enables you to request Stress, Strain, Nodal Force, and Reaction results to be calculated. For better performance, you can also choose to have these results expanded from Harmonic or Modal solutions. To expand reaction forces in the modal solution, set the Nodal Force property to or .
Define Initial Conditions
Basic general information about
this topic
... for this analysis type:
The Harmonic analysis must point to a Modal analysis in the Modal (Initial Conditions) object. This object also indicates whether the upstream Modal analysis is pre-stressed. If it is a pre-stress analysis, the name of the pre-stress analysis system is displayed in the Pre-Stress Environment field, otherwise the field indicates None. The Modal Analysis must extract enough modes to cover the frequency range. A conservative rule of thumb is to extract enough modes to cover 1.5 times the maximum frequency in the excitation.
Note:
Command objects can be inserted into Initial Conditions object to execute a restart of the solution process for the Modal Analysis.
If displacement loading is defined with Displacement, Remote Displacement, or Bolt Pretension (specified as , , or ) loads in the Static Structural analysis, these loads become fixed boundary conditions for the Harmonic solution. This prevents the displacement loads from becoming a sinusoidal load during the Harmonic solution.
Apply Loads and Supports
Basic general information about this
topic
... for this analysis type:
The following loads are allowed for the linked analysis:
- Inertial
Acceleration (Phase Angle not supported.)
- Loads
Pipe Pressure (line bodies only)
Force (applied to a face, edge, or vertex)
Bearing Load (Phase Angle not supported.)
Given a specified Displacement
- Direct FE
The Direct FE option is supported for node-based Named Selection scoping and constant loading only.
Acceleration as a base excitation
Support Limitations
Note the following analysis requirements.
Remote Force is not supported for vertex scoping.
Moment is not supported for vertex scoping on 3D solid bodies because a beam entity is created for the load application.
During a linked MSUP Harmonic analysis, if a Remote Force or Moment scoped to an internal remote point is specified with the Behavior property set to , the boundary conditions cannot be scoped to the edges of line bodies such that all of their nodes in combination are collinear.