When your upstream External Model source file includes surface to surface contact, from either solid or shell bodies, an Imported folder appears beneath the Connections parent folder when you open the file in Mechanical. This object is a simple group folder. It contains the child object: Contacts. The data associated with the imported contact is provided through the Worksheet. You can Check/Uncheck Worksheet entries using the selection box in the table or through the right-click context menu.

Imported contact is supported by the following analysis types:
Harmonic Response
Modal
Static Structural
Transient Structural
Steady State Thermal
Transient Thermal
Note: The application imports thermal conductivity data for thermal analyses.
The application imports the following source file data as contact:
CDB: surface contacts in the form of CONTA173 and CONTA174, (source) CONTA175 (source), and TARGE170 (target) elements.
NASTRAN: Not supported.
ABAQUS: *CONTACT PAIR of TYPE = NODE TO SURFACE & SURFACE TO SURFACE. All other optional parameters are not supported.
For *SURFACE BEHAVIOR: The application supports all required parameters plus one optional parameter, *NO SEPARATION.
For *SURFACE INTERACTION: The application supports the required parameters only.
For *FRICTION: The application supports required parameters only.
For *GAP CONDUCTANCE: The application supports gap conductance as a table of gap pressure or gap clearance. All the tabular values are averaged and used as a single thermal conductance value in the contact pair.
*TIE command: The application supports the required parameters only.
See the Imported: Contact object reference section for additional information.