Nonlinear Controls for Steady-State, Static, and Transient Analyses

This topic examines the Nonlinear Controls as they apply to Steady-State, Static, and Transient Structural Analyses, which include Electric, Magnetostatic, Static Structural, Transient Structural, Steady-State Thermal, and Thermal-Electric analyses.

Newton-Raphson Option

For nonlinear Static Structural and Full Transient Structural analysis types, the Newton-Raphson Option property is available. This property allows you to specify how often the stiffness matrix is updated during the solution process. Newton-Raphson Option property options include:

The Program Controlled option allows the program to select the Newton-Raphson Option setting based on the nonlinearities present in your model. For more information about the additional options, see the Newton-Raphson Option section in the Mechanical APDL Structural Analysis Guide. If you experience convergence difficulties, switching to an Unsymmetric solver may aid in Convergence.

Convergence Criterion

When solving nonlinear steady-state, static, or transient analyses, an iterative procedure (equilibrium iterations) is carried out at each substep. Successful solution is indicated when the out-of-balance loads are less than the specified convergence criteria. Criteria appropriate for the analysis type and physics are displayed in this grouping. Convergence controls are “step aware”. This means that the setting can be different for each step.

The following convergence criteria properties are available:

The following convergence controls are available for each of these properties:


Note:  If you do not want any convergence options to be turned on, then you may try setting the solution controls to off, using a Commands Objects object.


Line Search

Line search can be useful for enhancing convergence, but it can be expensive (especially with plasticity). You might consider setting Line Search on in the following cases:


Note:  The Line Search control is “step aware” and can be different for each step.


Stabilization

Convergence difficulty due to an unstable problem is usually the result of a large displacement for small load increments. Nonlinear stabilization technique can help achieve convergence. Nonlinear stabilization can be thought of as adding artificial dampers to all of the nodes in the system. Any degree of freedom that tends to be unstable has a large displacement causing a large damping/stabilization force. This force reduces displacements at the degree of freedom so stabilization can be achieved.

There are three Keys for controlling nonlinear stabilization:

There are two options for the Method property for stabilization control:

When Energy is specified, an Energy Dissipation Ratio needs to be entered. The energy dissipation ratio is the ratio of work done by stabilization forces to element potential energy. This value is usually a number between 0 and 1. The default value is 1.0e-4.

When Damping is specified, a Damping Factor value needs to be entered. The damping factor is the value that the ANSYS solver uses to calculate stabilization forces for all subsequent substeps. This value is greater than 0.


Note:  The Damping Factor value is dependent on the active unit system and may influence the results if unit systems are changed. You may wish to use an initial trial value from a previous run for this entry (such as a run with the Energy Dissipation Ratio as input). See the Controlling the Stabilization Force section of the Mechanical APDL Structural Analysis Guide for additional information.


There are three options for Activation For First Substep control:

For Stabilization Force Limit, a number between 0 and 1 should be specified. The default value is 0.2. To omit a stabilization force check, set this value to 0.

Refer to Unstable Structures in the Mechanical APDL Structural Analysis Guide for assistance with using the stabilization options listed above.


Release 18.2 - © ANSYS, Inc. All rights reserved.