Overview and Probe Types

The following probe types are available:

You insert a Probe object under Solution in the tree, from the toolbar or from a right mouse button click. You can adjust options in the Details view or add results for specific points/geometry. When you solve the probe, the display of the result probe reveals the displaced mesh for the specified time. The probe shows values over time and for a specified time. The Details view shows either the maximum or minimum value over time.


Note:  You cannot turn off the time history for result probes.


Scoping

Probes are customized for the particular result type, therefore, different probes enable different scoping mechanisms. For example, a reaction probe allows scoping to a boundary condition while a stress probe will allow scoping to an x, y, z location on the geometry. Refer to the “Characteristics” column of the tables in the linked sections above for scoping. Use Location Method in the Details view of the probe to scope to the desired entity.

When you create a probe by selecting a location on the model or by assigning a coordinate system, Mechanical associates a small subset of nodes that reside near the probe. The value of this probe is interpolated from the values at these neighboring (undeformed) nodes. The interpolation is based on the original node locations and not a function of the displaced position of the probe or of the nodes. When picking a specific x, y, z location, you can obtain the probe result directly at the closest corner node, without extra interpolation, by right-clicking on the probe object in the tree and choosing Snap to mesh nodes from the context menu. The identification number of the closest corner node is displayed as the Node ID in the Details view of the probe in the Results category. See the Interpolation section for additional information.


Note:
Line Body

If you attempt to intersect probes with a line body, Mechanical issues a warning message. No results (such as stresses or displacements) will appear in the details view of the probe.

Surface Body

For surface bodies with expanded thickness, because the snapping location is located on the expanded mesh, while other items such as the original x, y, z location and the node ID are on the non-expanded mesh, you are advised to turn the visual expansion off in order to best view these items.

Element Face

Probes do not support element face scoping.


Specific Scoping Requirements

Note the following specifications when scoping a probe:

Scoping Limitations

Reaction, Summation, and Torque

If you apply a Force Reaction or Moment Reaction, Force Summation, or Torque probe using a geometry entity (Location Method = Geometry Selection) that shares more than one body, then the (unscoped) adjacent elements of the scoped body can contribute to the probe's results. The Geometry Selection option, regardless of whether you select vertices, edges, or faces, chooses only nodes on the entity. The application then also selects any elements attached to the nodes. As a result, you can have additional elements (that contribute to the probe results) that are not included in the geometry scoping.

Shells

Shell element node-based results (like stress and strain) exist at the top, bottom, and middle of the shell element (or the layer). Therefore, a shell node can have three values for a given layer.

For result probes on shell models that are scoped by Geometry Selection, the probe normally considers the top value and bottom values at the scoped nodes and picks either the maximum or minimum value. Based on the probe type, the Spatial Resolution property enables you to select whether the application uses the maximum or minimum value.

If you scope your probe to a Coordinate System, the application performs an interpolation using the values at the top and bottom of the shell.

With these situations in mind, your scoping may present results with unexpected or non-intuitive values.

For example, consider a probe scoped to a coordinate system that is situated near a vertex at the mid-plane. For this situation, the interpolation is a simple arithmetic average. However, what if the Top value at the node is -1000 and the Bottom value at the same node is 1000, a very real scenario for shell models. The coordinate system probe would report (-1000 + 1000)/2 = 0.

Now consider the probe scoped by geometry to the same Vertex. It would report max(-1000, 1000) = 1000 if the Spatial Resolution property was set to Use Maximum.

Results Output Coordinate System

Some probes such as the Directional Deformation probe allow the results to be calculated and displayed in a coordinate system of your choice. Some other probes such as a Spring probe allow results to be output only in a specific coordinate system. Refer to Orientation Coordinate System: entry under the “Characteristics” column in the probe tables (see links above) regarding what coordinate systems are allowed and what the default coordinate system is. You can use Orientation in the Details view of the probe to change the output coordinate system.


Note:  When the Orientation Coordinate System is Global Cartesian, the triad symbol is not displayed. The exception is for Torque probes in magnetostatic analyses, where the global triad is displayed and the direction vector is placed at the global origin.


Limitations of Geometry-Based Probes

The following table shows the limitations of geometry-based Probe results. If you make incorrect selections in the Details view for any of the probes, all the probes under solution remain unsolved.

Probe Scope Must be Scoped to a rigid part Components and Principals Result Selection invalid All Result Selection invalid
DeformationVertices, Edges, Faces, or Volume  X
Stress XX
Strain XX
Thermal Flux1   X
Flux Density1   X
Flux Intensity1   X
Velocity  X
Acceleration  X
Position X  
Angular Velocity1  X  
Angular Acceleration1  X  

1 - Not supported in explicit dynamics analyses.


Release 18.2 - © ANSYS, Inc. All rights reserved.