Response Spectrum Analysis

Introduction

Response spectrum analyses are widely used in civil structure designs, for example, high-rise buildings under wind loads. Another prime application is for nuclear power plant designs under seismic loads.

A Response Spectrum analysis has similarities to a Random Vibration Analysis. However, unlike a Random Vibration analysis, responses from a Response Spectrum analysis are deterministic maxima. For a given excitation, the maximum response is calculated based upon the input Response Spectrum and the method used to combine the modal responses. The combination methods available are: the Square Root of the Sum of the Squares (SRSS), the Complete Quadratic Combination (CQC) and the Rosenblueth's Double Sum Combination (ROSE). See Response Spectrum Options Category for further details.

Points to Remember

Preparing the Analysis

Create Analysis System

  Basic general information about this topic

  ... for this analysis type:

Because a response spectrum analysis is based on modal responses, a modal analysis is a required prerequisite. The modal analysis system and the response spectrum analysis system must share resources, geometry, and model data.

From the Toolbox, drag a Modal template to the Project Schematic. Then, drag a Response Spectrum template directly onto the Modal template.

Define Engineering Data

  Basic general information about this topic

  ... for this analysis type:

Material properties must be defined in a modal analysis. Nonlinear material properties are not allowed.

Attach Geometry

  Basic general information about this topic

  ... for this analysis type:

There are no specific considerations for a response spectrum analysis.

Define Part Behavior

  Basic general information about this topic

  ... for this analysis type:

You can define rigid bodies for this analysis type.

Define Connections

  Basic general information about this topic

  ... for this analysis type:

Nonlinear element types are not supported. They will be treated as linear. For example, the contact stiffness is calculated using the initial status without convergence check.

Apply Mesh Controls/Preview Mesh

  Basic general information about this topic

  ... for this analysis type:

There are no specific considerations for a response spectrum analysis.

Establish Analysis Settings

  Basic general information about this topic

  ... for this analysis type:

For a Response Spectrum analysis, the basic Analysis Settings include:

Options for Analyses - Response Spectrum Analyses

Perform the following settings for a Response Spectrum analysis:

  • Specify the Number of Modes To Use for the response spectrum calculation. It is recommended to include the modes whose frequencies span 1.5 times the maximum frequency defined in the input response spectrum.

  • Specify the Spectrum Type to be used for response spectrum calculation as either Single Point or Multiple Points. If the input response spectrum is applied to all fixed degrees of freedom, use Single Point, otherwise use Multiple Points.

  • Specify the Modes Combination Type to be used for response spectrum calculation. In general, the SRSS method is more conservative than the CQC and the ROSE methods.


Note:  The Inertia Relief option (under Analysis Settings) for an upstream static structural analysis is not supported in a response spectrum analysis.


Output Controls

By default, only displacement responses are calculated. To include velocity and/or acceleration responses, set their respective Output Controls to Yes.

Damping Controls

allow you to specify damping for the structure in the response spectrum analysis. Controls include: Constant Damping Ratio, Stiffness Coefficient (beta damping), and a Mass Coefficient (alpha damping). They can also be applied as Material Damping using the Engineering Data tab. For the CQC mode combination type, non-zero damping is required.


Note:  Damping is not applicable to the SRSS combination method. Damping Controls are not available when the Modes Combination Type property is set to SRSS.


Analysis Data Management

These settings enable you to save solution files from the response spectrum analysis. An option to save the Mechanical APDL application database (db file) from the analysis is provided.

Define Initial Conditions

  Basic general information about this topic

  ... for this analysis type:

A specific Modal Environment must be set as an initial condition/environment for response spectrum analysis to be solved.

Apply Loads and Supports

  Basic general information about this topic

  ... for this analysis type:

  • Supported boundary condition types include fixed support, displacement, remote displacement and body-to-ground spring. If one or more fixed supports are defined in the model, the input excitation response can be applied to all fixed supports.

  • Remote displacement cannot coexist with other boundary condition types (for example, fixed support or displacement) on the same location for excitation. The remote displacement will be ignored due to conflict with other boundary conditions.

  • Note that the All boundary condition types for Single Point Response Spectrum only includes those fixed degree of freedoms defined using Fixed Support, Displacement, Remote Displacement and Body-to-Ground Spring. To apply an RS load to All boundary condition types for Single Point Response Spectrum, at least one allowed boundary condition must be defined.

  • For a Single Point spectrum type, input excitation spectrums are applied to all boundary condition types defined in the model. For Multiple Points however, each input excitation spectrum is associated to only one boundary condition type.

  • Three types of input excitation spectrum are supported: displacement input excitation (RS Displacement), velocity input excitation (RS Velocity) and acceleration input excitation (RS Acceleration). See RS Base Excitation for further details.

  • The input excitation spectrum direction is defined in the global coordinate system for Single Point spectrum analysis. For Multiple Points spectrum analysis, however, the input excitation is defined in the nodal coordinate systems (if any) attached to the constrained nodes.

  • More than one input excitation, with any different combination of spectrum types, is allowed for the response spectrum analysis.

  • Specify option to include or not include contribution of high frequency modes in the total response calculation by setting Missing Mass Effect to Yes or No. The option for including the modes is normally required for nuclear power plant design.

  • Specify option to include or not include rigid responses to the total response calculation by setting Rigid Response Effect to Yes or No. The rigid responses normally occur in the frequency range that is lower than that of missing mass responses, but is higher than that of periodic responses.

  • Missing Mass Effect is only applicable to RS Acceleration excitation. See the RS Base Excitation section of the Help for more information.

  • For a Single Point spectrum type, the entire table of input excitation spectrum can be scaled using the Scale Factor setting. The factor must be greater than 0.0. The default is 1.0.

Solve

  Basic general information about this topic

  ... for this analysis type:

It is recommended that you review the Solution Information page for any warnings or errors that might occur during the ANSYS solve. You may receive some warning messages and still be able to solve the analysis.


Note:  When using a Response Spectrum system database from a version prior to the most current version of Mechanical, it is possible to encounter incompatibility of the file(s) file.mode, file.full, and/or file.esav, created by the modal system. This incompatibility can cause the Response Spectrum system’s solution to fail. In the event you experience this issue, use the Clear Generated Data feature and resolve the modal system.

Refer to the Obtain the Spectrum Solution section of the MAPDL Structural Analysis Guide for more information.


Review Results

  Basic general information about this topic

  ... for this analysis type:

  • To view strain/stress results, a selection must be made in Output Controls of the modal analysis. By default, only Deformation drop-down menu results are available.

  • Applicable Deformation results are Total, Directional (X/Y/Z), Directional Velocity and Directional Acceleration. If strain/stress are requested, applicable results are normal strain and stress, shear strain and stress, and equivalent stress.

  • Equivalent stress is a derived stress calculated using component stresses.

  • Results are displayed as a contour plot on the model.

  • In addition to standard files generated by the Mechanical APDL application after the solve, the file Displacement.mcom is also made available. If the Output Controls are set to Yes for Calculate Velocity and/or Calculate Acceleration, the corresponding Velocity.mcom and/or Acceleration.mcom are also made available. These files contain the combination instructions including mode coefficients.

  • Force Reaction and Moment Reaction probes can be scoped to a Remote Displacement, Fixed Support, or Displacement boundary conditions to view Reactions Results.


    Note:  When you scope a Moment Reaction probe to a Fixed Support or a Displacement, the Summation property must be set to Centroid.


  • These probe results are not supported when the Missing Mass Effect and/or Rigid Response Effect properties of the RS Acceleration base excitation are set to Yes.

  • When the Missing Mass Effect property is set to Yes, the Deformation results that include the data from property in their result calculation are the Directional (Deformation/Displacement) and Directional Acceleration results. Note that the application supports the Directional Velocity result; however, it does not incorporate Missing Mass Effect conditions for its calculation.

  • The Directional (Deformation/Displacement) result is a relative result whereas Directional Velocity and Directional Acceleration are absolute results.

  • A Directional Acceleration result at or near fixed supports scoped to an RS Acceleration are correctly calculated by setting the Missing Mass Effect property and the Rigid Response Effect property to Yes. Corresponding properties display and require definition when these two properties are included.

File Management

When solving a Response Spectrum analysis in "In Process" solve mode, the pre-requisite files from the upstream Modal system are referenced by specifying the full path of their location (refer to RESUME and MODDIR commands) instead of making copies in order to improve solution time and disk usage. Please see the Solve Modes and Recommended Usage section of the Help for more information about the different solve modes.

When you are solving in the "Out of Process" mode, the application copies the pre-requisite files from the Modal analysis to the Response Spectrum Solver Files Directory. This may increase the required solution time for large models.

For additional technical information, refer to the Spectrum Analysis section of the Mechanical APDL Structural Analysis Guide as well as the MMASS command and the RIGRESP command in the Mechanical APDL Command Reference.


Release 18.2 - © ANSYS, Inc. All rights reserved.