All result objects can be scoped to:
Geometry selections - edges, a single vertex, faces, parts, bodies, or the entire assembly.
Geometry-based Named Selections.
Node selections of the underlying mesh.
Element or Element Face selections of the underlying mesh.
Make sure that your result objects conform to the following:
If you scope a result to one or more geometric entities (body, face, edge, or vertex) and subsequently suppress all of the bodies associated with the scoped entities, the application, by default, sets the scoping to . However, the application still stores the suppressed geometric entity set for future reference. Therefore, if any of the bodies associated with the scoped entities are later unsuppressed, the result scoping is set back to the originally defined (unsuppressed) geometric entities. If this behavior is undesirable, it is recommended that you use a Named Selection to define the scoping of the result.
Once a solution is computed, the scope of the result object cannot change. You must either add a new result object with the desired scope, or you can right-click that result item, and choose to change its scope.
Result scoping has an impact on convergence. Refinement does not happen outside the scope for a given convergence control. Multiple convergence controls are possible, however.
See the following subsections for additional information specific to the type of result scoping you wish to perform:
For a Composite Analysis, elemental strain and elemental stress results, elemental coordinate system results, User Defined Results (for Structural analyses), and heat flux results (for Thermal Analyses), can be scoped to Analysis Ply objects using the Sub Scope By property and the corresponding Ply property. The result calculation uses the intersection of the specified Ply and the Geometry property scoping. When scoping ply objects, the associated geometry selection needs to be based on either bodies or elements. Body- and element-based Named Selections are supported. In addition, for shell topologies, you can scope to a face (which represents an entire element).
Automated Result Scoping for Composites
The Imported Plies object, as well as all of its child objects, offer an automated option for creating results, including User Defined Results. Right-clicking on a ply object provides the following dynamic menu options that enable you to create and scope a result at the same time.

Depending upon the level within the Imported Plies object that you select, you can create individual results, as shown below, or you can create a group of results.
|
![]()
|
![]()
|
This example shows the creation of results for all of the individual plies within a ply group. The feature created a group of six results and scoped them accordingly. Once you create a group, the rules for Group Tree Objects apply.
|
![]()
|
![]()
|
![]()
|
If your analysis includes multiple environments, only supported environments display on the menu and, only result objects supported by the given scoping display as the menu extends. As illustrated in the following example, multiple supported environments are selected and the supported result types for the Transient Thermal selection are the only options available. See the Result Context Toolbar section for additional information about how results are graphically represented following a solution.

Note: Direct graphical node or element selection requires you to generate the mesh and have the Show Mesh tool turned on.
The following are known characteristics related to node-based scoping:
If all nodes of an element face are scoped, then Mechanical will draw contour bands on the entire face.
If some nodes of an element face are not scoped, then Mechanical will draw the face as transparent and draw the scoped nodes in contour colors.
As is the case with other scoping that occurs within a body (such as vertex or edge), any applicable averaging is done considering all of the nodes on a body.
Unlike results scoped to geometries or nodes, results scoped to elements evaluate only the scoped elements. No adjacent elements are considered. The example results shown below illustrate this behavior. Refer to the Averaged vs. Unaveraged Contour Results section of the Help for additional information on this topic.
The following results illustrate contour bands for all nodes.
|
Global Averaged Result Max. = 205 and Min. = -50 |
Global Unaveraged Result Max. = 276 and Min. = -74 |
|
![]()
|
![]()
|
The following results illustrate contour bands for elements only.
|
Result Scoped to One Element Max. = 276: Matches the Global Unaveraged Result (Min. Value = 127) |
Result Scoped to Three Elements Max. = 205: Matches the Global Averaged Result Min. = -74: Matches the Global Unaveraged Result |
|
![]()
|
![]()
|