You can insert a known temperature (not from data transfer) boundary condition in an analysis by inserting a Thermal Condition object and specifying the value of the temperature in the Details view under the Magnitude property. If the load is applied to a surface body, by default the temperature is applied to both the top and bottom surface body faces. You do have the option to apply different temperatures to the top and bottom faces by adjusting the entry in the details view. When you apply a thermal condition load to a solid body, the Shell Face property is not available in the Details view. You can add the thermal condition load as time-dependent or spatially varying.
When a Thermal Condition is specified on the Top or Bottom shell face of a surface body, the opposite face defaults to the environment temperature unless it is otherwise specified from another load object.
For an assembly of bodies with different topologies (solid body, line, shell, beam), you must define a separate Thermal Condition load for each topology, that is, you must define one load scoped to line bodies, define a second load scoped to surface bodies, and so on.
For each load step, if an Imported Body temperature load and a Thermal Condition load are applied on common geometry selections, the Imported Body temperature load takes precedence. See Activation/Deactivation of Loads for additional rules when multiple load objects of the same type exist on common geometry selections.
If the Thermal Condition is applied to a shell face that has a Layered Section applied to it, you must set Shell Face to Both in order to solve the analysis.
Thermal Condition is available for the following analysis types:
This section describes the characteristics of the boundary condition, including the application requirements, support limitations, and loading definitions and values.
Dimensional Types
3D Simulation: Supported.
2D Simulation: Supported.
Geometry Types: Geometry types supported for the Thermal Condition boundary condition include:
Solid: Supported.
Surface/Shell: Supported.
Wire Body/Line Body/Beam: Supported.
Topology: The following topology selection options are supported for Thermal Condition.
Body: Supported. The Thermal Condition is a body-based boundary condition.
Face: Not Supported.
Edge: Not Supported.
Vertex: Not Supported.
Nodes: Not Supported.
Loading Types: The Thermal Condition boundary condition’s loading is defined by Magnitude only.
Loading Data Definition : Enter loading data using one of the following options.
Constant (only option for Eigenvalue Buckling analyses).
Tabular (Time Varying).
Tabular (Step Varying): Supported for Static Structural analysis only.
Tabular (Spatially Varying).
Function (Time Varying).
Function (Spatially Varying).
To apply a Thermal Condition:
On the Environment context toolbar: click Loads>Thermal Condition. Or, right-click the Environment tree object or the Geometry window and select Insert>Thermal Condition.
Define the Scoping Method. This property has two options: and . For either scoping type, you must use the body selection filter (on the Graphics Toolbar) for geometry selection or Named Selection definition. Only solid bodies, surface body faces, or line bodies can be selected or defined.
For surface bodies, in the Details view, the Shell Face property provides a drop-down list. Select Top, Bottom, or Both (default) to apply the thermal boundary condition to the selected face. For bodies that have one or more layered section objects, you need to specify Both for Shell Face or the Thermal Condition will be under-defined and an error message will be generated.
Define the Magnitude, Coordinate System, and/or Direction of the thermal boundary condition based on the above selections.
The selections available in the Details view are described below.
| Category | Fields/Options/Description |
|---|---|
| Scope |
Scoping Method, options include:
|
| Definition |
Type: Read-only field that displays boundary condition type - Thermal Condition. : Temperature value. The default is 22 degrees Celsius. Suppressed: Include ( - default) or exclude () the boundary condition. |
The following Mechanical APDL commands, element types, and considerations are applicable for this boundary condition.