Preparing the Topology Optimization Analysis

This section describes the requirements to create your analysis, prepare the analysis settings, and define the design objectives and constraints in order to perform the optimization.

Creating and Preparing the Analysis System

If you have not already created a Topology Optimization system that is preceded by a Static Structural or Modal system or a combination of structural and modal analyses in the Project Schematic, see the Topology Optimization section in the Workbench User's Guide for the steps to create these systems. The cells between the systems should be linked as illustrated below.

Upstream Static Structural System

Multiple Upstream Systems

Once your systems are open in Mechanical, The Future Analysis property of the Analysis Data Management Category in the Analysis Settings object of the upstream system is specified as Topology Optimization. The Environment Selection List property in the Solution object of the Topology optimization system shows the cell identifiers of the environments linked to the current topology optimization environment.

As illustrated below, the application automatically inserts and assigns default values to the optimization region, objective, and constraint objects in the Topology Optimization analysis. In this example, fixed supports and a Remote Force were specified on the model.

Establishing Analysis Settings

The application applies default settings to the Analysis Settings properties, however, you may wish to modify them as described below.

Definition Category

The Definition category of the Analysis Settings is only available when performing a Topology Optimization analysis. The properties of the Definition category include:

  • Maximum Number of Iterations: This property specifies the maximum number of iterations performed for the topology optimization analysis. The solution process continues until the application achieves convergence accuracy or reaches the maximum number of iterations. The default value is 500.

  • Minimum Normalized Density: This property requires a value greater than 0 and less than 1. The topology optimization analysis uses this value to extract the permissible range of retained threshold values. The default value is 0.001.

  • Convergence Accuracy: This property specifies the convergence criteria of the topology optimization analysis. The solution process continues until the application achieves convergence accuracy or reaches the maximum number of iterations. This value must be less than or equal to 2. The default value is 0.1%.


    Note:  Specifying a lower Convergence Accuracy, such as 0.05%, is recommended if your optimization objective is to minimize Mass/Volume with Global/Local von-Mises stress constraint.


Solver Controls Category

Solver Type property is the only property for this category. The property options include:

  • Program Controlled (default): The application selects the Sequential Convex Programming solver as the default option.

  • Sequential Convex Programming: The Sequential Convex Programming method is an extension of the method for moving asymptotes (MMA). The Sequential Convex Programming method requires the derivatives of all functions present in the topology optimization analysis.

    See the Optimization Solver Methods section for additional technical detail about this solver type.

  • Optimality Criteria: The Optimality Criteria method can be used to solve topology optimization problems with a simple compliance objective that uses a volume or mass constraint.


    Note:  The following support limitations apply to the Optimality Criteria method:

    • Only supports the Compliance (Structural) setting for the Response Type column of the Objective object worksheet.

    • Only Volume and Mass constraints are supported.

    • The Manufacturing Constraint is supported where only the Minimum property for the Member Size constraint subtype can be specified.


    See the Optimization Solver Methods section for additional technical details about this solver type.

Output Controls Category

See Output Controls for additional information about the properties of this category.

Analysis Data Management Category

See the Analysis Data Management Category section of the Help for additional information about the properties of this category.

For a general overview of the use of analysis settings, see the Establish Analysis Settings section.

Applying Design Objectives and Constraints

A Topology Optimization analysis includes the following design objectives and constraints. Refer to individual Help sections for additional information about the object. The application applies default settings to the various properties of all of the automatically inserted objects.


Note:  The Mechanical APDL solver supports the use of the Commands object for Topology Optimization analyses. This support includes all iterations of the Topology Optimization analysis and for all load steps.


Additional Preparation Topics

Refer to the following additional sections in order to complete the preparation of your Topology Optimization analysis:


Release 18.2 - © ANSYS, Inc. All rights reserved.