Mechanical's Map Trace Data feature provides a fast and efficient method to model Printed Circuit Boards (PCBs) and packages that would otherwise require an inordinate amount of time to process a geometry and mesh. Typically, the geometry that you produce in your electronic computer-aided design (ECAD) system contains a large number of bodies and therefore large amounts of data. Given the complexity of the system, producing a mesh can be very difficult. The Map Trace Data feature simplifies your model by modeling the geometry as dielectric layers and includes the effect of traces by mapping the metal fraction onto the dielectric layers.
Mapping takes place in two stages. As illustrated below, during the first stage, a representation of the layout is built upon a rectangular grid using the data from a specified ECAD layout. The cell size of the grid is governed by the smallest features in the layout that have to be resolved. This size can be controlled by the user and should be specified based on the resolution required. A metal fraction value is assigned to each cell depending on the contribution of metal to that cell. The metal fraction value ranges from 0 to 1, where the 0 value represents a pure dielectric material and 1 a pure metal material.
The conduction paths that connect the metal traces between the different layers, i.e., the vias, can be specified as either hollow or solid (default).
|
Building a Representation Upon a Rectangular Grid | |
|
![]()
|
During the second stage, the metal fraction values are mapped from the source grid to the target mesh. Once the mesh is created, Mechanical then generates the mapped metal fractions. The sequence of this construction is illustrated below.
|
Mapping Metal Fractions | ||
|
![]()
|
The following workflow is typical for this analysis in Mechanical:
Import supported ECAD files into External Data and update your project.
Add the supported Mechanical system to the project.
Add appropriate materials using Engineering Data .
Import the ECAD layout geometry into Workbench using SpaceClaim Engineer or SCDM.
Connect the External Data Setup cell to the analysis system's Model cell.
Launch Mechanical.
Specify vias as required.
Assign Dielectric material to the bodies.
Assign appropriate ECAD File to Imported Trace object.
Verify that the Trace layout source is properly aligned with geometry.
Assign Metal material to Imported Trace layers.
Define and generate mesh.
Set discretization.
Generate the trace mapping.
Define boundary conditions.
Solve the analysis.
This workflow requires the following components or systems:
Engineering Data: This component enables you to define materials required for the analysis. The materials defined the in the Engineering Data component will be available in the corresponding Mechanical model. For your convenience two materials (FR-4 and Copper Alloy) which commonly represent dielectric and metal in a PCB are available in the General Materials sample library.
Geometry: This component enables you to create or import the geometry representing the board or the package layout. The SpaceClaim geometry editor enables you to directly import the supported ECAD formats (see below) and automatically create a Trace Layout geometry. See the ECAD section in Importing and exporting in the SpaceClaim documentation for details.
External Data: This component enables you to specify the ECAD file for import in Mechanical. The following ECAD File formats are supported by External Data for Trace Analysis:
Cadence BRD/MCM/SIP
ODB++ TGZ
Ansoft ANF
Icepak BOOL+INFO
Icepak COND+INFO
Once an ECAD file is specified in External Data, additional Rigid Transformation controls are available in the component to align the trace data with geometry.
Mechanical Systems: The supported Mechanical systems enable you to import Trace Data, setup the analysis and solve. The following analysis are supported:
Harmonic Response
Modal
Static Structural
Transient Structural
Steady-State Thermal
Transient Thermal
See Trace Mapping in Mechanical for the specifics of setting up a Trace Analysis.
You should review the ECAD tutorial, Thermal Induced Stresses on a PCB, located on the Customer Portal, for a PCB model that has thermal induced stresses applied to it.