VMMECH025

VMMECH025
Stresses Due to Shrink Fit Between Two Cylinders

Overview

Reference:Stephen P. Timoshenko, Strength of Materials, Part 2 - Advanced Theory and Problems, 3rd Edition, pg. 208-214
Solver(s):
ANSYS AIM
ANSYS Mechanical
Analysis Type(s):Linear Static Structural Analysis
Element Type(s):Solid

Test Case

One hollow cylinder is shrink fitted inside another. Both cylinders have length L and both the flat faces of each cylinder are constrained in the axial direction. They are free to move in radial and tangential directions. An internal pressure of P is applied on the inner surface of the inner cylinder. To get accurate results, apply a global element size of 0.8 inches.

Find the maximum tangential stresses in both cylinders.

Material PropertiesGeometric PropertiesLoading
Both cylinders are made of the same material
E = 3 x 107 psi
ν = 0
ρ = 0.28383 lbm/in3
Inner Cylinder:
ri = 4”
ro = 6.005”
Ri = 6”
Ro = 8”
Length of both cylinders = 5”
P = 30000 psi

Analysis Assumptions and Modeling Notes for ANSYS Mechanical

The following figure shows the finite element model in ANSYS Mechanical:

Figure 94:  Schematic

Schematic


Note:  Tangential stresses can be obtained in the Mechanical application using a cylindrical coordinate system.

To simulate interference, set Contact Type to Rough with interface treatment set to add offset with Offset = 0.


Analysis Assumptions and Modeling Notes for ANSYS AIM

The following figure shows the finite element model in ANSYS AIM:

Figure 95:  ANSYS AIM Schematic

ANSYS AIM Schematic

Results Comparison for ANSYS Mechanical

ResultsTargetMechanicalError (%)
Maximum normal y stress, inner cylinder (psi)35396.67357581.020802
Maximum normal y stress, outer cylinder (psi)42281.09422970.037629

Note:  Here y corresponds to θ direction of a cylindrical coordinate system.


Results Comparison for ANSYS AIM

ResultsTargetAIMError (%)
Maximum Normal Y Stress, Inner Cylinder (psi)35396.6735824.91.210
Maximum Normal Y Stress, Outer Cylinder (psi)42281.0942327.450.110

Release 18.2 - © ANSYS, Inc. All rights reserved.